Drawing : Section view : Arrows

[Ktelang]

Hello,

I need to change the arrow style from that available in inventor to custom defined one.

Precisely I want arrow to look as in image attached (circle type of arrow).

I tried editing the sketch of the section line but its not helping.

I tried defining sketch symbol but the extension line still remains in the view.

Please can anybody help ?

[johnsonshiue]

I am not quite following what you meant by "extension lines still show in the view." Could you post an image of your custom-made symbol or attached the IDW file with the sketch symbol defined?

Thanks!

[Ktelang]

Thanks for your time.

The extension line is the line between the

section line and the arrow head. Please see the

attached picture.

I have changed the arrow style to none. But thats not enough

I do not want the remaining line  (extension line too)

Thanks again

[Anonymous]

I have the same issue with making the section line symbol look like a Civil Engineering type style.

Did you have any luck making a work around?

[Lewis.Young]

Hi there,

I have a solution, but this may not work for your exact drawing.

If you go into the annotation style and change the format so its the first one, it will change the style of the extension line.

Now, if you're lucky, the extension line will now overlap an existing line so it's essentially hidden. Then all you have to do is double click on the text and simply remove what's in the text box.

This of course isn't a solid answer to your question, but there doesn't seem to be a real way of removing the line completely.

Anyway, I hope this helps 🙂

Lewis

[MechMachineMan]

"Extension line length" set to 0 doesn't remove it?

[Lewis.Young]

I'm pretty certain the extension value can't be set to "0", not sure why though, it would save a lot of time!

[evettem]

IS THERE A SOLUTION FOR THIS YET?

[MechMachineMan]

YES.

Create sketched symbols to place over the endpoints of the section lines. Hide the native section line arrows as shown above in this thread.

If that isn't good enough for you, pay someone to write you code that automatically inserts them, or go find/make the idea on the idea forums.

[Anonymous]

Hi 

I think I have a fix to your problem. If you don't want to see the section line (or detail circle/boundary) in a base view - double click on the Section (or Detail) view. Select the "Display Options Tab" . There is a check box "Definition in Base View" if this is unchecked the section line won't be displayed.

Other option is to put the Section line on a layer that doesn't print.

[Cris-Ideas]

Quite old,

but I am just struggling with the same problem.

Solution I found is to set:

Extension Line length = 0.01mm

arrow type = None

X scale = 0.01mm

This basically removes extension line as far as all practical applications are concerned.

The end of the line is no more available for dragging from the sheet level and for any edit you need to enter the sketch, or temporarily style of the section line

Cris

Cris.

[Cris-Ideas]

@johnsonshiue 

Hi Johnson,

since you are in this tread, do you know the way of controlling the length of the last visible segment of the section line? The one that does not get turned off when "show entire section line" option is off.

I tried every available parameter I could think off and nothing worked o far.

Cris.

[rhasell]

My solution to the problem:

Set the section line layer to non printable, I also changed the colour so that it is more visible, and indicates something that does not print.

I am now so used to it and managing section lines is a thing of the past, I don't have to worry about the exact length or placement, as it is never seen, and I can make them as long or short as I wish. My DWG export automatically hides the section layer.

[Cris-Ideas]

Different angle of approach.

Will explore this direction. 

Cris.