Is "master" model state name localized?

[nmunro]

Can't seem to find an answer to this anywhere. Is the name for the master model state (ModelStateName) changed in localized versions of Inventor?

[bradeneuropeArthur]

What do you exactly mean with "changed in localized versions of Inventor"?

[nmunro]

In a non-English language Inventor version, is "Master" translated to the local equivalent.

[Curtis_Waguespack]

Hi @nmunro 

I think it would be a different name. And in fact in Inventor 2023 they discarded the name "Master" and use "Primary" for the English versions. I think the safest way to access the "built in" model state is probably via item number as in this example.

I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com

	Dim oDoc As AssemblyDocument
	oDoc = ThisApplication.ActiveDocument	    
    
	Dim oModelStates As ModelStates 	
	oModelStates = oDoc.ComponentDefinition.ModelStates 	
	
	'get the built in model state
	oBuilt_In_MS = oModelStates.Item(1)	
	
	MsgBox(oBuilt_In_MS.Name,,"iLogic")

[nmunro]

Thanks Curtis, your solution was one on my list. Still would like to know if anyone can check a localized version.

[Michael.Navara]

Use string identifiers are common, but bad practice. Use built-in enums instead. It is not culture (language) specific. Here is sample how to detect master model state

Dim asm As AssemblyDocument = ThisDoc.Document
Dim activeModelState As ModelState = asm.ComponentDefinition.ModelStates.ActiveModelState
Logger.Debug("Active model stsate is {0}", activeModelState.ModelStateType)
If activeModelState.ModelStateType = ModelStateTypeEnum.kMasterModelStateType Then
	Logger.Debug("Master model state")
End If

[bradeneuropeArthur]

Does this help you further?

Dim oDoc As AssemblyDocument
	oDoc = ThisApplication.ActiveDocument	    
    
	Dim oModelStates As ModelStates 	
	oModelStates = oDoc.ComponentDefinition.ModelStates 

	
	Dim ms As Inventor.ModelState
	
	For Each ms In oModelStates
	If ms.ModelStateType = Inventor.ModelStateTypeEnum.kMasterModelStateType Then
			
		MsgBox("Model state Master")
	Else If ms.ModelStateType = Inventor.ModelStateTypeEnum.kCustomModelStateType Then
			
		MsgBox("Model state Custom")	
		
	Else If ms.ModelStateType = Inventor.ModelStateTypeEnum.kSubstituteModelStateType Then
			
		MsgBox("Model state Substitute")
		
	Else If ms.ModelStateType = Inventor.ModelStateTypeEnum.kLastActiveModelStateType Then
			
		MsgBox("Model state Active")
	End If
		Next
	'get the built in model state
	oBuilt_In_MS = oModelStates.Item(1)	

[CattabianiI]

No one mentioned the proper class to manage localization, so I add some links:

• https://help.autodesk.com/view/INVNTOR/2023/ENU/?guid=GUID-89DFDECC-6735-4423-9D0F-1794E8D02048

' Method that returns whether the input primary model state string
' is valid or not. The input primary model state string can be in 
' any language that Inventor supports.
ThisApplication.LanguageTools.IsValidPrimaryModelState(PrimaryName As String) 

• (and no link for this one because Inventor Help website sucks )

' Read-only property that returns the primary ModelState string in current language.
ThisApplication.LanguageTools.CurrentPrimaryModelStateString

[WCrihfield]

Just pointing out another set of ModelState related tools that you (and others) may like.

One of these seems to contain a tool that sounds like an exact match for checking your request.

This appears to be a direct way get the 'localized' version of a supplied ModelState name.

Dim oMSName As String = "Master"
Dim oMSNUtils As New Autodesk.iLogic.Runtime.ModelStateNameUtils
Dim sLocalizedName As String = oMSNUtils.GetLocalizedName(oMSName)
MsgBox("The 'Localized' version of " & oMSName & " is:  " & sLocalizedName, vbInformation, "iLogic")

The main tool being used there (ModelStateNameUtils) could be used without the "Autodesk.iLogic.Runtime" part, but I just added that so others would know where it is being sourced from, but the 'Runtime' source is already referenced for us automatically by the iLogic Add-in, when working within the iLogic Rule Editor dialog.  However, I could not find an online help area web page which documents this tool, or I would have provided a link to it here.  This tool appears to be somewhat of a 'behind the scenes' resource which appears to have most of the same functionality as the LanguageTools referred to by @CattabianiI.  It has the following members:

Then there is the ModelStateUtils tool, which is also sourced from the 'Autodesk.iLogic.Runtime' reference, and also does not appear to have an online help webpage.  This is a really helpful and interesting tool, with several 'members', and you do not need to 'instantiate' it (no need to create a variable for it, or use 'New' to create one), which is also really nice.  Some of us may recognize some of these 'members' as having similar sounding normal API counterparts.  Again, this may be a 'behind the scenes' resource type tool.  Probably just for providing a 'shortcut' of sorts.  This tool has the following 'members':

Then there is the ModelStateOperations tool, which is also from the Runtime source, and does not need to be instantiated, but only has two methods.  Not super useful, but nice to know its there.

Then there are also a few ModelState related tools under the FileManager object (ThisApplication.FileManager), which there is actually a online help webpage for.