To Edit User Parameter from within current Sketch

[RoyWickrama_RWEI]

In my skeleton modeling, the master sketch is too big and contains so many user parameters. Some times, need to edit the user parameter on the fly.

Could I get some iLogic code to edit the user parameter by selecting the dimension (for example, Length_03 as shown below)?

[MechMachineMan]

In the DIMENSION box, as shown, type:

Length_03 = 10

where 10 is your new value.

No iLogic required.

[rhasell]

Hi

I have been following this thread, as I have the same question, does this now work in the new version of Inventor?

I still only have 2018, and it does not work for "User Parameters", only "Model parameters"

Thanks

[RoyWickrama_RWEI]

Thanks for the reply.

I have a little code created. But it is lacking to get copied the name of the assigned-user-parameter of the dimension selected.

Please see attached sample file.

I appreciate if you could help.

[RoyWickrama_RWEI]

Thanks. You are right. I need to get around this. I appreciate if you could help.

[chandra.shekar.g · Accepted solution]

@RoyWickrama_RWEI,

Hoping that below iLogic code would help to edit user parameter of selected dimension.

Sub Main()
	Dim oSelectedDim As DimensionConstraint
	oSelectedDim = ThisApplication.Commandmanager.Pick(SelectionFilterEnum.kSketchDimConstraintFilter,"Select a dimension to change dimension")
    
    If oSelectedDim.Parameter.DrivenBy.Count > 0 Then
        Dim oUserParam As UserParameter
        oUserParam = oSelectedDim.Parameter.DrivenBy.Item(1)
        
        oUserParam.Expression = InputBox("Editing user parameter '" & oUserParam.Name & "'", "Edit user parameter", "10") 
    Else
        MsgBox ("Selected dimension is not contianing any user parameter")
    End If

    iLogicVb.UpdateWhenDone = True
End Sub

Please feel free to contact if there is any queries.

If solves problem, click on "Accept as solution" / give a "Like".

Thanks and regards,

[RoyWickrama_RWEI]

It works, I keep using.

I have a little concern. After editing the user parameter, it closes the sketch being edited. Can I have the sketch remaining so that the other edits too can be done and close the sketch by myself.

Thanks.