iLogic get preparation drawing view document

[Nejc.Leban]

Hello everyone,

I'm trying to get the part document of a "Preparation" placed drawing view. On the image below, 10796-07-001-00.iam is the main weldment document. VIEW719 is pos.8 and VIEW720 is pos.11 (10796-06-001-11.ipt). These two are placed on the drawing via Place Views - Base - Model - Preparation(select part), see second image below. What I'm trying to get with iLogic is the part document of each placed view.
Some context - I have automated the placement of views of all occurrences in an assembly. I would now like to check if a view of an occurrence already exists so it doesn't place another view.

I've tried with this:

Dim oViewDoc As Document = oView.ReferencedDocumentDescriptor.ReferencedDocument

and this: 

Dim viewModelDoc = ActiveSheet.View("VIEW720").ModelDocument.DisplayName

But it gives me the main assembly document and not the part document.

I suppose there's a relatively simple way to get the referenced part, but I can't find it.

I'd really appreciate any suggestions.

Best regards.

[Andrii_Humeniuk · Accepted solution]

Hi @Nejc.Leban .
In this case, you can get an object of type ComponentOccurrence using the DrawingView.GetWeldmentState method. Example iLogic code:

Dim oInvApp As Inventor.Application = ThisApplication
Dim oView As DrawingView
oView = oInvApp.CommandManager.Pick(SelectionFilterEnum.kDrawingViewFilter, "Select View...")
If oView Is Nothing Then Exit Sub
Dim eWeld As WeldmentStateEnum
Dim oObj As Object
Call oView.GetWeldmentState(eWeld, oObj)
If Not eWeld = WeldmentStateEnum.kPreparationsWeldmentState Then Exit Sub
Dim oOcc As ComponentOccurrence = oObj
MessageBox.Show(oOcc.Name, eWeld.ToString())

[Nejc.Leban]

That works great, thank you!