View Label Formatting
Your view label is using "Current-Ansi Big Text"
Go to the "object defaults" section of the style manager and find the "View/Scale Label" object and change the text style there..
Hi ToddPig,
If you right-click on your view label on the drawing, and choose Edit Text Style, it will take you directly to the style used by that label. There you can set the bold and justification options.
This is true of most things concerning styles in the drawing environment.
I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com
Hi ToddPig,
So to recap:
- you created a new style,
- next you would then select the existing view label
- go to the Annotation tab
- choose your new style from the style pull down
- now you can right click on the label on the drawing and choose Edit Text style, and know that you're editing the correct style
- in the text editor and make changes as needed
- and then you would want to set the object defaults to always use this text style for your view labels.
I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com
@Curtis_Waguespack wrote:
wait, I got confused
So to recap:
- you created a new
label style, Standard- next you would then select the existing view label
go to the Annotation tabchoose your new style from the style pull down- now you can right click on the label on the drawing and choose Edit Text style, and know that you're editing the correct style
- in the text editor and make changes as needed
- and then you would want to set the object defaults to always use this modified text style for your view labels, and this view label style for your views
Hi ToddPig,
You've created/modified a new Standard, but it's unclear to me if that is really what you wanted to do.
Standards are a collection of sub styles. Object Defaults are a sub style that dictates which other sub styles the Standard uses by default.
Here is a quick video that creates a new standards, then creates a new sub style (this one happens to be a text style), and then edits the Object Defaults sub style to set the View Label to always use the new text style by default.
I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com
@ToddPig wrote:
Curtis,
Thanks for taking the time to make the video.
1) What I'm trying to do is create a drawing template that has all the settings/styles set-up so when I create a drawing I don't have to change the same things every time.
In Solidworks, I would open an existing template, make all the changes, then save it as a new template (in 2 different formats for some reason, but that is a discussion for the SW forum).
I would like to do something similar, but am only able to make a few changes, and not others. For example. I made changes to the revision table, my title block is importing iproperties from the ipt or iam file, but there are a few that I can't change. The section view label is one of them .
2) In your video above, am I supposed to add a part to my drawing, then set the style, then delete the part, then save the template?
3) I'll admit that I'm still confused with the relationship between Standards, Styles or Sub-styles, and Object Defaults. As always, your book is helping, and I'm getting closer (and making other changes that I didn't know I could), 4) but I still have not figure out how to adjust the view label justification and font.
Hi ToddPig,
1) making these changes to the template file is the correct method. Once that is done you can push those changes to a Styles Library, so that all existing drawings will update to use these new styles. But that's a step or 2 down the road from where you are now. I suspect the 2 different formats in Solidworks is something similar to the styles library in Inventor, but I don't know for sure as I didn't set those things up back when I used Solidworks (and that was a long while ago).
2) You only need to add a model view to the drawing if you are looking to pull in that custom iProperty into a drawing resource, such as a title block, see this link:
3) It always helped me to think of it like this
- Standards: a collection of styles (i.e. a company standard)
- Styles: a collection of settings (i.e. a dimension style)
- Sub Styles: some styles are used in a setting of another style (dimension style "Shop Drawings" uses text style "Dim Text Arial 0.125 - Bold")
- Object Defaults: a configuration list that sets the which style the standard uses by default ( i.e. there are 3 dims styles present, the object defaults ensures that one called "Shop Drawings" is the default one).
4) You'll do this by adjusting those things in a text style, and then set the view label Object Default to use that text style.
4a) Just saw the images you posted. I think you'll want to control the font, and justification in the Text style, and set the top line to be bold in the Standards > View Preferences, by using the Edit (pencil) button as you were doing previously.
I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com
Hi ToddPig,
So your word doc had the Object Defaults as I see them naturally, meaning that I don't see them as a "style", but Autodesk does.
As for the sub styles, I likely added some confusion here by misusing terms. In any case this is how the relationships work:
Styles just get consumed by other styles (including the object defaults "style")
I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com
