ANSI content in mm

[LeanderTorres]

Hi,

I adapted the ANSI ASTM pipes to show dimensions in mm.

Everything works when placing components directly from the content center. (part 8 on screenshot)

When I use the frame generator, it works, but the filename contains a unique number instead of the length.(part 2-7 on screenshot)

The checkbox in the frame generator for 'getting part number from CC' is checked.

Does annybody know how to solve this?

Your help is appreciated.

We are working with inventor 2019.4

[bradeneuropeArthur]

Hi,

How did you configure the part-number in the Content center Family?

Regards,

[LeanderTorres]

This is the custom expression I used.

{Nominal_Diameter}&" "&{Schedule}&" - Ø"&{Diameter_mm}&"x"&{Thickness_mm}&" - "&{B_L}

[LeanderTorres]

Here is a wetransfer link for the idcl file if helful.

https://we.tl/t-ZKttqLKPmC

[bradeneuropeArthur · Accepted solution]

Hi,

Since the length is calculated with Frame Generator this will not work this way.

In your part-number you need to use the Expression Like: #######- <Lenght>

The property "length" must be mapped to the Custom Property "length" using the "B_L" parameter.

This is the custom expression you need to used. {Nominal_Diameter}&" "&{Schedule}&" - Ø"&{Diameter_mm}&"x"&{Thickness_mm}&" - "&<B_L>

See this also:

https://www.autodesk.com/autodesk-university/class/AutodeskR-InventorR-Content-Center-Library-Advanc...

Regards,

[LeanderTorres · Accepted solution]

Hi,

Thank you Arthur.

This set me in the right direction. I had following dificulties.

={Nominal_Diameter}&" "&{Schedule}&" - Ø"&{Diameter_mm}&"x"&{Thickness_mm}&" - "&<B_L>

This didn't work, frame generator would return an empty value. (also the '=' at the beginning is essential for the <>-format to work)

Changing the B_L to G_L solved this problem.

={Nominal_Diameter}&" "&{Schedule}&" - Ø"&{Diameter_mm}&"x"&{Thickness_mm}&" - "&<G_L>

With G_L, the frame generator partnumbers are ok, memebers placed from CC had there length in inches.

The last problem was solved by adapting the family template. (this forum post helped me do this: https://forums.autodesk.com/t5/inventor-forum/how-to-change-g-l-parameter-from-in-to-mm/m-p/4386993#...)

Now everything works as it should be, length is updated with when changing base sketch and when doing end treatments.

Regards,