help, create an ordinateset on drawing

dhanna · ‎10-07-2022

good afternoon,

Trying to collect hole centers from 2 drawing views and add an ordinate set either up or down based on location of holes on view.

this causes the error:

System.Runtime.InteropServices.COMException (0x80004005): Unspecified error (Exception from HRESULT: 0x80004005 (E_FAIL))
at System.RuntimeType.ForwardCallToInvokeMember(String memberName, BindingFlags flags, Object target, Int32[] aWrapperTypes, MessageData& msgData)
at Inventor.OrdinateDimensionSets.Add(ObjectCollection GeometryIntents, Point2d PlacementPoint, DimensionTypeEnum DimensionType, Object DimensionStyle, Object Layer)
at ThisRule.Main()
at Autodesk.iLogic.Exec.AppDomExec.ExecRuleInAssembly(Assembly assem)
at iLogic.RuleEvalContainer.ExecRuleEval(String execRule)

<code>

Dim inv = ThisApplication
Dim oDoc = ThisDrawing.Document
Dim  cnt As Long

Dim cursht As Inventor.Sheet
Dim Jndx As Long
Dim oVw As Inventor.DrawingView
Dim oDcrv As Inventor.DrawingCurve
'On Error Resume Next

Dim oTG As Inventor.TransientGeometry = inv.TransientGeometry

'On Error Resume Next
Dim gIntent As Inventor.GeometryIntent

For Jndx = 30 To 31 '87
		Dim oUpr As Inventor.ObjectCollection = inv.TransientObjects.CreateObjectCollection
		Dim oLwr As Inventor.ObjectCollection = inv.TransientObjects.CreateObjectCollection
	
			cursht = oDoc.Sheets(Jndx)
			
Dim oviews As Inventor.DrawingViews = cursht.DrawingViews

				oVw = oviews(2)
				
						For Each oDcrv In oVw.DrawingCurves
						
							If oDcrv.CurveType = CurveTypeEnum.kCircleCurve Then 
								gIntent = cursht.CreateGeometryIntent(oDcrv.CenterPoint)
 										If gIntent.Geometry.Y >=  oVw.Position.Y  Then 
											oUpr.Add(gIntent)
											Else
												oLwr.Add	(gIntent)
										End If
							End If
												
						'MessageBox.Show(cnt,oVw.Name)
					Next   ' 'oDcrv
					
					
				If oUpr.Count >1 Then	
					''MessageBox.Show(OUPR(1).GEOMETRY.X & ", " & oVw.Position.Y + oVw.Height + 3, " UPPER pOSITION")
					
					cursht.DrawingDimensions.OrdinateDimensionSets.Add(oUpr, _
							oTG.CreatePoint2d(oUpr(1).GEOMETRY.X, oVw.Position.Y + oVw.Height ), _
							DimensionTypeEnum.kVerticalDimensionType)
				End If
				
					If oLwr.Count >1 Then
						
						''MessageBox.Show(OUPR(1).GEOMETRY.X & ", " & oVw.Position.Y - oVw.Height - 3, "LOWER pOSITION")
						cursht.DrawingDimensions.OrdinateDimensionSets.Add(oLwr, _
									oTG.CreatePoint2d(oLwr(1).GEOMETRY.X, oVw.Position.Y - oVw.Height ), _
									DimensionTypeEnum.kVerticalDimensionType)
					End If			

oVw = oviews(5)

					oLwr.Clear
					
					For Each oDcrv In oVw.DrawingCurves
						
							If oDcrv.CurveType = CurveTypeEnum.kCircleCurve Then 
												oLwr.Add	(gIntent)
							End If	

					Next   ' 'oDcrv

Next   'Jndx

<\code>

dalton98 · ‎10-10-2022

Hello. I would recommend you look at the sample program for creating ordinate dimensions.

Top right inventor program > (?) icon > Help > Programming/ API Help

Then search "Create ordinate dimension API Sample" > Sample Programs > Drawings > "Create Ordinate Dimension"

Also, I understand your though process on wanting to create the dimension above/ below the view based on the hole position, but in your drawing the holes are vertically aligned, so you want two dimensions for the same position? What if the hole is centered and doesn't favor top/bot? Just some thoughts

dhanna · ‎10-11-2022

Good morning;

Thanks for the reply, however, I do not see in the sample where I went wrong. True, the holes look to be vertically aligned, yet most will not be and only a little out of alignment thus the upper and lower divide to ordinate sets.

The following error occurs

System.Runtime.InteropServices.COMException (0x80004005): Unspecified error (Exception from HRESULT: 0x80004005 (E_FAIL))
at System.RuntimeType.ForwardCallToInvokeMember(String memberName, BindingFlags flags, Object target, Int32[] aWrapperTypes, MessageData& msgData)
at Inventor.OrdinateDimensionSets.Add(ObjectCollection GeometryIntents, Point2d PlacementPoint, DimensionTypeEnum DimensionType, Object DimensionStyle, Object Layer)
at ThisRule.Main()
at Autodesk.iLogic.Exec.AppDomExec.ExecRuleInAssembly(Assembly assem)
at iLogic.RuleEvalContainer.ExecRuleEval(String execRule)

========

when it gets to the 'add'.

I've changed it up a bit to see if I could get the error to pop where I could find it, as such

<code>

If oUpr.Count >1 Then	
					
 Dim tmppnt As Inventor.Point2d = oTG.CreatePoint2d(oUpr.Item(1).GEOMETRY.X, oVw.Position.Y + oVw.Height)
 MessageBox.Show(oUpr.Item(1).GEOMETRY.X & ", " & oVw.Position.Y + oVw.Height + 3, " UPPER pOSITION")
			 
cursht.DrawingDimensions.OrdinateDimensionSets.Add(oUpr, tmppnt, DimensionTypeEnum.kVerticalDimensionType)
End If
				
If oLwr.Count >1 Then
Dim tmppnt As Inventor.Point2d = oTG.CreatePoint2d(oLwr.Item(1).GEOMETRY.X, oVw.Position.Y - oVw.Height )
MessageBox.Show(oUpr.Item(1).GEOMETRY.X & ", " & oVw.Position.Y + oVw.Height + 3, " lower pOSITION")

cursht.DrawingDimensions.OrdinateDimensionSets.Add(oLwr, tmppnt, DimensionTypeEnum.kVerticalDimensionType)
End If

<\code>

dhanna · ‎10-11-2022

this is an example of what I'm attempting to setup

dalton98 · ‎10-11-2022

You cant place all ordinate dimensions with one command, you will need to do each individual one. Ex.

For i = 1 to oUpr.Count
cursht.DrawingDimensions.OrdinateDimensionSets.Add(oUpr(i), tmppnt, DimensionTypeEnum.kVerticalDimensionType)
Next

dhanna · ‎10-11-2022

I get the following error with that change:

System.InvalidCastException: Unable to cast COM object of type 'System.__ComObject' to interface type 'Inventor.ObjectCollection'. This operation failed because the QueryInterface call on the COM component for the interface with IID '{6939FFDD-BA10-11D2-B779-0060B0F159EF}' failed due to the following error: No such interface supported (Exception from HRESULT: 0x80004002 (E_NOINTERFACE)).
at ThisRule.Main()
at Autodesk.iLogic.Exec.AppDomExec.ExecRuleInAssembly(Assembly assem)
at iLogic.RuleEvalContainer.ExecRuleEval(String execRule)

===========

also, the 2018 API Help DrawingDimensions.OrdinateDimensionSets.Add method shows an object collection of GeometryIntents

OrdinateDimensionSets.Add( GeometryIntents As ObjectCollection, PlacementPoint As Point2d, DimensionType As DimensionTypeEnum, [DimensionStyle] As Variant, [Layer] As Variant )

could it be because I didn't specify dimensionstyle or layer optionals from an external rule?

the rule with the recommended change:

<code>

Dim inv = ThisApplication
Dim oDoc = ThisDrawing.Document
Dim  cnt As Long

Dim cursht As Inventor.Sheet
Dim Jndx As Long
Dim oVw As Inventor.DrawingView
Dim oDcrv As Inventor.DrawingCurve
'On Error Resume Next

Dim oTG As Inventor.TransientGeometry = inv.TransientGeometry

'On Error Resume Next
Dim gIntent As Inventor.GeometryIntent

For Jndx = 33 To 33 '87
Dim oUpr As Inventor.ObjectCollection = inv.TransientObjects.CreateObjectCollection
Dim oLwr As Inventor.ObjectCollection = inv.TransientObjects.CreateObjectCollection

cursht = oDoc.Sheets(Jndx)

Dim oviews As Inventor.DrawingViews = cursht.DrawingViews

oVw = oviews(2)

For Each oDcrv In oVw.DrawingCurves

If oDcrv.CurveType = CurveTypeEnum.kCircleCurve Then 

gIntent = cursht.CreateGeometryIntent(oDcrv.CenterPoint)
MessageBox.Show(gIntent.Geometry.y.tostring,oVw.Position.Y.ToString)
If gIntent.Geometry.Y >=  oVw.Position.Y  Then 
oUpr.Add(gIntent)
Else
oLwr.Add	(gIntent)
End If
End If


Next   ' 'oDcrv

'MessageBox.Show(oUpr.Count,oLwr.Count)
If oUpr.Count >1 Then	

Dim tmppnt As Inventor.Point2d = oTG.CreatePoint2d(oUpr.Item(1).GEOMETRY.X, oVw.Position.Y + oVw.Height)
MessageBox.Show(oUpr.Item(1).GEOMETRY.X & ", " & oVw.Position.Y + oVw.Height + 3, " UPPER pOSITION")

'cursht.DrawingDimensions.OrdinateDimensionSets.Add(oUpr,tmppnt, DimensionTypeEnum.kVerticalDimensionType)

For i = 1 To oUpr.Count
cursht.DrawingDimensions.OrdinateDimensionSets.Add(oUpr(i), tmppnt, DimensionTypeEnum.kVerticalDimensionType)
Next

End If

If oLwr.Count >1 Then
Dim tmppnt As Inventor.Point2d = oTG.CreatePoint2d(oLwr.Item(1).GEOMETRY.X, oVw.Position.Y - oVw.Height )
MessageBox.Show(oUpr.Item(1).GEOMETRY.X & ", " & oVw.Position.Y + oVw.Height + 3, " lower pOSITION")

'MessageBox.Show(OUPR(1).GEOMETRY.X & ", " & oVw.Position.Y - oVw.Height - 3, "LOWER pOSITION")
'cursht.DrawingDimensions.OrdinateDimensionSets.Add(oLwr, tmppnt, DimensionTypeEnum.kVerticalDimensionType)

For i = 1 To oLwr.Count
cursht.DrawingDimensions.OrdinateDimensionSets.Add(oLwr(i), tmppnt, DimensionTypeEnum.kVerticalDimensionType)
Next
End If			

oVw = oviews(5)

oLwr.Clear

For Each oDcrv In oVw.DrawingCurves

If oDcrv.CurveType = CurveTypeEnum.kCircleCurve Then 
oLwr.Add	(gIntent)
End If	

Next   ' 'oDcrv

Next   'Jndx

<\code>

dalton98 · ‎10-11-2022

Oh ok I misunderstood. I got it to work for me by changing 2 things:

gIntent = cursht.CreateGeometryIntent(oDcrv, kCenterPointIntent)

'changing oUpr.Item(1).Geometry.X to oUpr.Item(1).PointOnSheet.X

'its a good habit to always define the objects you are working with so i defined
the ordinate dimension set

'also ordinate set dimensions are opposite of what the are so kVerticalDimensionType changes
to kHorizontalDimensionType

Here is the code I altered and got to work:

Dim inv = ThisApplication
Dim oDoc = ThisDrawing.Document
Dim  cnt As Long

Dim cursht As Inventor.Sheet
Dim Jndx As Long
Dim oVw As Inventor.DrawingView
Dim oDcrv As Inventor.DrawingCurve
'On Error Resume Next

Dim oTG As Inventor.TransientGeometry = inv.TransientGeometry

'On Error Resume Next
Dim gIntent As Inventor.GeometryIntent


Dim oUpr As Inventor.ObjectCollection = inv.TransientObjects.CreateObjectCollection
Dim oLwr As Inventor.ObjectCollection = inv.TransientObjects.CreateObjectCollection

cursht = oDoc.ActiveSheet

Dim oviews As Inventor.DrawingViews = cursht.DrawingViews

oVw = oviews(1)

For Each oDcrv In oVw.DrawingCurves

If oDcrv.CurveType = CurveTypeEnum.kCircleCurve Then 

gIntent = cursht.CreateGeometryIntent(oDcrv, kCenterPointIntent)
'If gIntent.Geometry.Y >=  oVw.Position.Y  Then 
oUpr.Add(gIntent)
'Else
'oLwr.Add	(gIntent)
'End If
End If


Next   ' 'oDcrv

'MessageBox.Show(oUpr.Count,oLwr.Count)
If oUpr.Count >1 Then	

Dim tmppnt As Inventor.Point2d = oTG.CreatePoint2d(oUpr.Item(1).PointOnSheet.X, oVw.Position.Y + oVw.Height)
'MessageBox.Show(oUpr.Item(1).GEOMETRY.X & ", " & oVw.Position.Y + oVw.Height + 3, " UPPER pOSITION")

'cursht.DrawingDimensions.OrdinateDimensionSets.Add(oUpr,tmppnt, DimensionTypeEnum.kVerticalDimensionType)


Dim ordSet1 As OrdinateDimensionSet

ordSet1 = cursht.DrawingDimensions.OrdinateDimensionSets.Add(oUpr, tmppnt, DimensionTypeEnum.kHorizontalDimensionType)
End If

dhanna · ‎10-11-2022

@dalton98

Thank you so very much. That got me to where I needed to be. I hadn't even looked at pointonsheet. in the docs.

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help, create an ordinateset on drawing

help, create an ordinateset on drawing

help, create an ordinateset on drawing