Projected View....but only to a certain depth.

[IsomaAde]

Hello All

I am currently working on an assembly drawing for one of our machines.

I have created a main view (side elevation) and varoius projected views to show all other sides.

My plan is to show all views with hidden lines removed but not rendered.

The side view that I have created (machine left hand side) shows the parts that I want to show on the left hand side but it also shows parts on the far side of the frame that I do not want to show. I could select these lines and turn off the visability in the view but this is a mammoth job. My other option, which works quite well, is to created a section view that isn't a section view. I have placed the section line outside the machine frame and then edited the section properties from full to a distance (half way thru the machine frame), this then gives me the view I want.

My question is...is there an easier way to do this or have I hit upon the best way of doing it?

Thanks for reading

Ade

[rayessle · Accepted solution]

Instead of using a projected view make the required view by using a section view with a stated depth.

You can switch off the section mark by unticking the "definition in base view" in the view options.

Ray.

[IsomaAde]

Hi Ray

Thanks for your reply.

That's what I have done, I was wondering if these was another way of doing it that's all.

Cheers

Ade

[rayessle]

Sorry,

just realised that what was what you did. I read it as being you took the section off the sheet then projected the view back on. My bad.

Ray

[IsomaAde]

No worries Ray

[SBix26]

Your method sounds like the best one to me. 

If you'd prefer to just make lines invisible-- select the "far side" components in the browser, then right click and select Select As Edges, then turn off visibility or change layers, etc.  IOW, you don't have to select all the individual edges one at a time.

Sam B

Inventor Professional 2018.2.3
Windows 7 SP1

[SteveMDennis]

@IsomaAde

Couldn't you project the view and then crop that view to only show to the desired depth?

[dan_inv09]

Sorry for dredging this back up but, I'm trying to do the same thing as the OP and I absolutely can not see it left with a response like that from a "Sr. Principal Engineer".

Is there a way to crop perpendicular to the page?

That is what we are looking for, but I am unfamiliar with the mechanics of that.

(I think I recall a release a long time ago where there was a bug which allowed you to look at an .idw in 3D, but that was long before cropping views and drawing the bounding box would probably still be difficult anyway.)

(There might be a way to get the result we are looking for using Cut Inheritance but that would require extra views and not be any better than the actual methods suggested further up the thread. I wonder if maybe that was what Steve Dennis was thinking.)

[johnsonshiue]

Hi Dan,

I am sorry I might be misunderstanding the issue. I thought setting the section depth would create the desirable result. So does Slice View. Am I missing something here?

Many thanks!

[dan_inv09]

I'm not sure slice would help.

Yes, Section Depth appears to be the only way to do it (it would be nice if you could somehow switch a projected view if you have already started ballooning/dimensioning/etc.).

It's just that Steve suggested Crop.

Can you think of any way that Crop can replace Section Depth? How can I Crop a view a certain depth into the page?

[SteveMDennis]

As I follow this train of thought again, my suggestion is probably bunk. Keep in mind I am a developer not a power user like Johnson. Unless I have coded up a particular part of Inventor I am not likely to be identified as a power user.

[dan_inv09]

If there was a way to do it it might actually be better.

Maybe call it something else, but if you could code a way to set a depth for hidden lines in a projected view that would be wonderful. Whether it's a box to type a in the depth, or an invisible (when it's not being (re)positioned) line in the parent view.

Actually, a Section Depth is not really the best - sometimes it looks odd if the visible lines are missing, if you know what I mean. You want the full "outside" profile, just remove some of the hidden line clutter.

[dan_inv09]

It turns out I'm doing both of the methods suggested earlier. Well, I have a Section Depth for the big end, but for the smaller end - instead of "Select As Edges, then turn off visibility or change layers" I just turned off the hidden edges for parts at the other end. I still want the visible edges to be exactly the same as the projected view.

If you're working on implementing this, that's what it should do: just affect the visibility of the hidden edges for parts past the halfway point (maybe with a way to adjust from there (and leave the current behavior as default with an option to turn on "hidden halfway" (or whatever it will be called))).

[suneelkumarYX7P2]

Hii ray, I couldn't find any option for switching off the section mark could you please guide me where this view options is present?

[rayessle]

double click the view. in the drawing view dialog go to the 'Display Options' tab and untick the 'Definition in Base View' checkbox.

[suneelkumarYX7P2]

@rayessle got it thank you very much.