Placing multiple holes in frame generator part

[Anonymous]

Hello,

I have a part made using the Frame Generator. There are lugs various distances apart and 2 different sizes. What method would you recommend for adding Holes into all Lugs. Small Lugs have 1 Hole at size 10 and Large Lugs have 2 Holes at 14 size

Thanks

Peter

[salariua]

Are the lugs placed with Frame Generator based on skeleton sketches?

If you have used reused then adding hole to one part would have updated the rest of reused components

It all depends on how you intend to document these holes as well. Do you expect them to show up at the part level (lugs)? then use the above method.

Do you expect them to show up in the assembly? if you don't really care about having it on the part and you will document them on the assembly drawing then you can use assembly hole feature and filter affected lugs with Add Participant / Remove Participant components.

TIP: if you isolate the components before doing the assembly level hole it will only affect visible components. Undo Isolate and select a different set before creating the second hole.

[Anonymous]

Thanks Adrian

Yes i added all the Lugs via 1 single skeleton Sketch. My earlier version does not have the option "Re-use"

Is it possible to see a screencast using the Add Participant / Remove Participant components

Thanks

Peter

[salariua]

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@Anonymous wrote:

Yes i added all the Lugs via 1 single skeleton Sketch. My earlier version does not have the option "Re-use"

Peter

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What version of Inventor are you using?

I assume you need them at the part level then? 

[Anonymous]

Yes at the part level. Version 2013

[salariua]

iFeature or Copy Feature will be just as slow as using Hole command.

If you need to do a bom and part drawing then might as well use Replace. Replace on Selection was not available in 2013 as far as I know and the members (lugs) need to have same orientation for this to work.

If I was you I would fake it. Add the hole at the assembly level, then create a view representation in the assembly with just the lug.

Create a new drawing, place a lug view outside the border (this is for ipropes and titleblock info) then place a view of the assembly (lug only design view rep) in the border.

You can always decide to document this on the assembly drawing with detail view or separate view (lug only design view rep).

[Mark.Lancaster]

@Anonymous

Little late to the party but not sure why you would need to fake it..    Unless I'm missing something here

Open the individual frame generator parts, toggle the browser from frame generator to model (see this document and recommendation #6/7 for more info) and place the holes using the normal hole command (and pattern if needed).

[salariua]

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@Mark.Lancaster wrote:

@Anonymous

Open the individual frame generator parts, toggle the browser from frame generator to model (see this document and recommendation #6/7 for more info) and place the holes using the normal hole command (and pattern if needed).

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That's the thing, Mark. There are too many individual parts (all the same) generated by FG as separate files.

It's not about adding multiple holes in a single part, but about adding a single hole, in the same place, same size to multiple files.

[Mark.Lancaster]

@salariua

Understood..  But my 2 cents..  I wouldn't fake it.    Spend the time and apply the holes at the part level and then detail the part out in a drawing.  No need to create special view reps or etc.  Anyhow my opinion.. 

[salariua]

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@Mark.Lancaster wrote:

@salariua

Understood..  But my 2 cents..  I wouldn't fake it.

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Got it... I must have misread your post.

I have worked in offices where you needed to detail every single part on its own drawing and worked in offices where quick sketch on a napkin was standard.

Now I am in between, and I detail all the parts on the assembly drawing.

[Mark.Lancaster]

@salariua

Very true...  I guess the point we are both trying to make here..    @Anonymous needs to do this per their company standard (if there's actually one)..

[johnsonshiue]

Hi Peter,

Have you tried using Bolted Connection at assembly level? It helps create fasteners really quickly and the holes are pushed to individual participating components.

Many thanks!