How to remove all the horizontal and vertical constraints

[gparamasivam]

Hello Everyone,

How to remove the all horizontal and vertical constraints in all the sketches with single shot or automatically.

If is this possible, Kindly guide me..

Advance Thanks...

[gparamasivam]

Hello Everyone,

How to remove the all horizontal and vertical constraints in all the sketches with single shot or automatically.

If is this possible, Kindly guide me..

Advance Thanks...

[Casey.P]

Hi @gparamasivam ,

So far, the best way I figured is if you hold control and left click select the constraints that you want to delete. Once you have them all selected, just hit the delete button....

You could window drag and then deselect all of the features and constraints that you don't want to delete, but I think this section option will take longer.

[Casey.P]

Hi @gparamasivam ,

So far, the best way I figured is if you hold control and left click select the constraints that you want to delete. Once you have them all selected, just hit the delete button....

You could window drag and then deselect all of the features and constraints that you don't want to delete, but I think this section option will take longer.

[JDMather]

Rotate.

[JDMather]

Rotate.

[imajar]

I think @JDMather  solution is the best to solve your specific problem, but you can also select all the geometry, right click and select delete all constraints.  The drawback, is it will also wipe out the other constraints (except coincident).

[imajar]

I think @JDMather  solution is the best to solve your specific problem, but you can also select all the geometry, right click and select delete all constraints.  The drawback, is it will also wipe out the other constraints (except coincident).

[JDMather]

Can you Attach your file here?

I can't help but wonder why you would want to do this.

In 15 years of using Inventor - I have never seen this need posted here before.

Turning the sketch into a Sketch Block, might be another option...

[JDMather]

Can you Attach your file here?

I can't help but wonder why you would want to do this.

In 15 years of using Inventor - I have never seen this need posted here before.

Turning the sketch into a Sketch Block, might be another option...

[gparamasivam]

It will delete the all parallel and perpendicular constraints also,

I need only delete the horizontal and vertical constraints  

[gparamasivam]

It will delete the all parallel and perpendicular constraints also,

I need only delete the horizontal and vertical constraints  

[gparamasivam]

In iFeature sketches should not have the horizontal and vertical constraints because it may cause make some issue on iFeature. So we have a to do not use horizontal and vertical constraints in iFeature sketches.

Hope you will understand our issue.

[gparamasivam]

In iFeature sketches should not have the horizontal and vertical constraints because it may cause make some issue on iFeature. So we have a to do not use horizontal and vertical constraints in iFeature sketches.

Hope you will understand our issue.

[JDMather]

---

@gparamasivam wrote:

So we have a to do not use horizontal and vertical constraints in iFeature sketches.

Hope you will understand our issue.

---

Ah, now I understand.  And I was incorrect in my previous statement. 😮

[JDMather]

---

@gparamasivam wrote:

So we have a to do not use horizontal and vertical constraints in iFeature sketches.

Hope you will understand our issue.

---

Ah, now I understand.  And I was incorrect in my previous statement. 😮

[gparamasivam]

No problem, thank you for your suggestion 

[gparamasivam]

No problem, thank you for your suggestion 

[CGBenner]

@gparamasivam  Did the information provided by answer your question? If so, would you please use Accept Solution so that others may find this in the future? Thank you very much!

[CGBenner]

@gparamasivam  Did the information provided by answer your question? If so, would you please use Accept Solution so that others may find this in the future? Thank you very much!

[gparamasivam]

No, still I did not get the right answer

[gparamasivam]

No, still I did not get the right answer

[CGBenner]

@gparamasivam 

Aside from the suggestions you have received here, I think you might be looking at the need to create an iLogic solution to do this automatically.  I'm not certain that it is even possible with iLogic, but you could try posting in the Inventor Customization forum, maybe one of the experts there will have a suggestion.

[CGBenner]

@gparamasivam 

Aside from the suggestions you have received here, I think you might be looking at the need to create an iLogic solution to do this automatically.  I'm not certain that it is even possible with iLogic, but you could try posting in the Inventor Customization forum, maybe one of the experts there will have a suggestion.

[gparamasivam]

Thank you for your suggestion 

[gparamasivam]

Thank you for your suggestion 

[mcgyvr · Accepted solution]

@gparamasivam 

Here you go this will delete all horizontal and vertical constraints in a part in all sketches..

Dim oPartDoc As PartDocument
Dim oSketch As PlanarSketch

Dim geoconstraint As GeometricConstraint

On Error Resume Next

oPartDoc = ThisApplication.ActiveDocument

For Each oSketch In oPartDoc.ComponentDefinition.Sketches
For Each geoconstraint In oSketch.GeometricConstraints
	If geoconstraint.Type = kHorizontalConstraintObject Then
		'MsgBox ("Deleting Horizontal Constraints")
Call geoconstraint.Delete
Else If geoconstraint.Type = kVerticalConstraintObject Then
			'MsgBox ("Deleting Vertical Constraints")
Call geoconstraint.Delete
End If
Next geoconstraint

Next oSketch

MsgBox ("All Horizontal and Vertical constraints deleted!")

[mcgyvr · Accepted solution]

@gparamasivam 

Here you go this will delete all horizontal and vertical constraints in a part in all sketches..

Dim oPartDoc As PartDocument
Dim oSketch As PlanarSketch

Dim geoconstraint As GeometricConstraint

On Error Resume Next

oPartDoc = ThisApplication.ActiveDocument

For Each oSketch In oPartDoc.ComponentDefinition.Sketches
For Each geoconstraint In oSketch.GeometricConstraints
	If geoconstraint.Type = kHorizontalConstraintObject Then
		'MsgBox ("Deleting Horizontal Constraints")
Call geoconstraint.Delete
Else If geoconstraint.Type = kVerticalConstraintObject Then
			'MsgBox ("Deleting Vertical Constraints")
Call geoconstraint.Delete
End If
Next geoconstraint

Next oSketch

MsgBox ("All Horizontal and Vertical constraints deleted!")

[gparamasivam]

Thank you, 

It is working and very useful to us.

[gparamasivam]

Thank you, 

It is working and very useful to us.