How to add/create an end cap/face for a Cylinder in Model Mode

[kevinwatts]

How to add/create an end cap/face for a Cylinder created in Scultp mode and now in the Model Mode? I am sure that this is a simple and basic question. The Fill Hole option is not available.

In Sculpt Mode I can create an end cap/face using the following procedure:

END CAP/FACE TO CYLINDER IN MODEL MODE
1. Select body
2. Enter Sculpt Mode (click on globe beside MODEL)
3. Select the Edge (double click to select the entire perimeter edge)
4. MODIFY → FILL HOLE
5. In the Fill Hole dialogue box adjust the setting to:
 a) MAINTAIN CREASE EDGES: CHECK MARK
 b) FILL HOLE MODE: FILL STAR (for a circle)
6. Check results and click OK

[jeff_strater]

Well, there is an easy answer and a "good" answer.  

The easy answer is to use the Patch command in the Patch workspace:

starting point:

Invoke Patch command:

Choose the cylinder perimeter:

Result:

Now, the problem here is that Patch is sometimes not very accurate.  For a cylinder, it should be OK, but...

The more accurate way is to use a surface Revolve.  Start by creating a work axis through the cylinder, then a Plane at Angle through the axis.  The angle does not matter:

Then, Sketch on that plane, and Project the cylinder top edge and the Work Plane into the sketch.

Break Link of the top edge projection and trim it against the projected axis (or, even simpler, just create this line  yourself...):

Then, use Revolve to create a circular surface body:

In both cases, (Patch and Revolve), use Stitch, to stitch the surface bodies together.

Hope this works for you

Jeff Strater (Fusion development)

[kevinwatts · Accepted solution]

Thank you Jeff. I appreciate the detailed explanation with screen shots. I tried the easy method first and it worked.