Filet command really?
Guessing games are fun, but a little more explanation of what you want to fillet would be helpful.
p.s. The red error in the timeline indicates that any operation you do may fail.
ETFrench
Sorry for not saying what I want to filet. One of those "thinking that everybody else know what I want to do"
I reviewed your comment about Red Warning. So I made new file, with same components.
I want to filet intersection of those two bodies.
I made both bodies in Fusion, Imported one as Component and Joined them. Fusion did 5mm Filet, I need 20mm. And, I need it all around, to the upper connection line.
Here is attached "clean" file, with started 5mm filet.
The best I can do is a 13.95mm fillet after creating the long horizontal piece as a single loft.
I suspect the problem area is circled in red.
ETFrench
In general the geometry so far looks simplistic and before moving to surfacing or filleting you consider upgrading your modeling techniques. So when you make a loft for example maybe use G1 or G2 as the start and end condition to get smooth transitions.
That can be in the Model or Patch workspace.
To really properly "fillet" this sort of geometry you need to probably move to surfacing and away from these solid modeling techniques. Other software might make fillets, but they still look terrible.
Also, you are filleting this way too early. Cosmetic fillets are secondary surfaces and should be applied once you are happy with your main shapes. Soon this model don't fillet then loft then fillet then combine then fillet some more.
The photo I posted was done in OnShape.
Here is a sample what 360 did with bottom joint, what is much more exposed to lofted area. It did it just perfect, 25mm.
I don't think you understood much of what I said.
Yes, Onshape created a solid modeled fillet in the area Fusion has a problem with. Fusion creates a fillet at the bottom that looks OK to you.
Neither of these fillets look acceptable to most product designers as most product designers - at least in the field of vehicle design and higher end consumer product design - work with surfacing software. To a degree you can do this as well with Fusion 360.
The difference between Onshape and Fusion 360 is the geometric modeling kernel. In Case of Fusion 360 thats a fork of the ACIS kernel and in case of Onshape it is a Parasolid kernel. Both have different strengths. In this case that manifests itself in Fusion 360 not creating a fillet that Onshape creates.
Be that as it may, you either create your design in Onshape, or you have to learn a different technique if you want to continue with Fusion 360. In my opinion, that different technique generates the better design, regardless of the software you are working with.
Is this a design you are willing to share ?
I'd love to see the whole thing and see what can be done with it.
I've looked at your model and the modeling techniques you have used really don't utilize the parametric nature of the timeline. So one question would be: Do you need for this model to be parametric ?
Meaning that for example you want to offer a model in different frame sizes, instead of completely re-modeling the entire bike - which is basically what you would have to do now - you change a hand full of dimensions and the CAD model adjusts itself to it.
I don't watch Lars' videos, because there are very few areas in the modeling and assembly area of Fusion 360 that I don't know 😉
Attached is a model that is a few years old where I experimented with how to make a parametric bicycle frame just from tubes. But the methodology os the same. You make your base frame sketch, similar to what you've started in the CL-Side sketch.
Then I make a number of construction Plane along Path at at eh end of these sketch line and sketch my profiles for extrusion, or lofting on these planes.
However, I've started to re-design the frame so it's more parametric.
for Lars Video
@veso58S5W wrote:
Don't know if that can be done at all, that Frame Geometry changes by some inputs.
I can assure you that can be done, but also there are limits. The arrangement between the individual tubes and the geometry of the tubes can all be parametrized and changed and these changes will propagate through the model
So far so good.
The difficulty will come in when we introduce fillets or more generally speaking transitional surfaces (fillets, blends) between the tubes to create the monocoque frame. Then these transitional surfaces can break and have to be fixed.
However, if the changes aren't too drastic then that also might just work out.
I might have some time trough the weekend to investigate this further.
