Drawing module annoying behaviour

[lnonnato]

Hello,

I face a rather annoying behaviour of the drawing module. I have a multi-component model and I want to create the respective drawings, one component per page.

I could do that, without much trouble. As a result, on the left of the screen I have the browser showing all the components names and, at the bottom, miniatures of the pages. On the browser, all the components are suppressed, except the one corresponding to the page I am working at - Perfect.

Changing the page changes also the unsupressed component - Perfect.

My problems are the following (see the attached screencast):

1 - For some pages, if I unsupress more than 1 component, nothing changes - this is what I expected

     For other pages, if I unsupress more than 1 component, I get a mess, with superposing drawings.

2 - In some cases, if I unsupress 2 components, the original drawing is modified and I have to re-anchor some dimensions.

Can somebody explain to me what is the exact function of the TOGGLE SUPPRESS operation, as it seems to either produce an erroneous result or do nothing. And more important, why this function causes a change in the drawing.

Cheers,

Luiz

[cmiller66]

Hi Luiz,

Sorry to hear this is causing issues for you.  If you create a sheet that has a base view for one component only, the browser in the drawing should show the full list of components in the design, all unchecked, except the one you created the sheet for.  At this point if you uncheck any of those other components, you should see that component also appear in the drawing.

Without seeing your drawing it is hard to say for sure what you're seeing.  From your description i am guessing you have a base and maybe projected views on your sheet, and when you toggle another component on, these components are getting added to the views and causing them to overlap.

I would not expect that unchecking (Unsuppressing) a 2nd component would result in no change on the sheet.  In any given view, the components that are toggled ON should appear in the view.  If you zoom to Fit, is it somewhere off the sheet?

Note that if you place a base view, and then place a 2nd base view on the same sheet, you get a duplicate component list in the browser.  This enables you to control the component visibility in each (and any projected views from each) individually.

If you have a parts list created for a base view, you will see that toggling the checkbox will suppress/unsuppress the component completely (visibility as well as removing it from the parts list).  If you toggle just the lightbulb On/Off, the visibility of the component will only be affected, not the parts list.

As far as the dimensions getting disassociated, if you have dimensions placed to a component and toggle that component off, I would expect the dimensions to get disassociated.  But if you have dimensions to a component and toggle a 2nd component on, there should be no change to those dimensions on the 1st component.  If they are getting disassociated, that would be a bug.

Can you send me your drawing so I can take a look?  From the data panel click the version number (V) for the drawing > Open Details on Web >  and then in upper right corner Export (down arrow) > Fusion 360 Archive and send it to christopher.miller@autodesk.com.

Thanks,
Chris

[SaeedHamza]

@lnonnato Your screencast isn't attached, please make sure to attach it for better understanding your problem

Regards

[lnonnato]

Hello Chris,

Thank you for your very thorough reply.

First of all, I should apologize for the error in attaching the screencast. I hope it is now OK.

With regard to the first of my questions, if I have a drawing of one component, check the SUPPRESS COMPONENT box and then uncheck it, all the drawing's dimensions will get dissociated. Even if it is a meaningless operation, I wonder why Fusion allows it (what is the utility of the SUPPRESS box, by the way ?).

The second question is more serious. If I have a drawing for one component and then uncheck SUPPRESS for a second component, some of the first component dimensions will become dissociated. You can see this at the last part of my screencast.

I will send you my drawing by email, as you suggest.

Regards,

Luiz

[cmiller66 · Accepted solution]

Hi Luiz,

I still don't see your screencast, but I did get your drawing. Thank you. From turning components on/off I think I can explain what you might be seeing.

First question first, what is the purpose of the Suppress checkbox?  In the drawing browser, the components that are checked will appear in the base view, those unchecked (or checked but with the visibility light bulb toggled off) will not.  If you place a parts list in the drawing, the components that are checked will be included.  If a component is checked but the visibility (lightbulb) is off, it will appear in the parts list, but not in the drawing views.

In the past we had a limitation where once you created a drawing (back then it was single sheet only) you couldn't add components to your existing views.  Now, even if you create a drawing (or sheet) of just one component, you can control what appears in the view - you can add components or change the component shown.  Using your drawing as an example, Sheet 6 is a detail of component SFU1605 only.  If I check component KFL000 the views in the sheet show both components, and the projected view on the right gets cluttered, because in the design these two components overlap.

If I switch to Sheet 7, only one component is shown, KFL000. Even though the others are checked, their visibility is Off. If I turn on the visibility for component SH12a, that component appears in the drawing, but now all the dimensions to section view E-E get disassociated.  This is because the extents of the base view changed, and the section line E-E is no longer cutting  component KFL000 as it originally did.  I can move the section line back to cut that component and the dimensions re-associate (I see one that did not, this could be a bug).

From what I can see, you have a nicely set up drawing here.  Unless you have a need to edit these views you can just ignore the browser.  If you do toggle the visible component off and the dimensions get disassociated, turning it back on (in the same session before Save) should reassociate them.  IF you see a wholesale disassociation of dimensions, like with that Section view, check to make sure the section line or detail view boundary is still cutting or enclosing the geometry you want it to.

Not sure if that answers your question though, please let me know.

Thanks,
Chris

[lnonnato]

Hello Chris,

Thanks for the information. I think I have now a better understanding of the multi-component drawing proccess.

However, my problem persists: when I have a component drawing on screen, toggle off SUPRESS for a second component and then toggle it on, a couple of dimensions in the original drawing become unnassociated (in this cased 2 dimensions amongst 23) . I don't know why my screencast is not attached correctly, but I send you a picture showing that .

Cheers,

Luiz