Copying components
If you have to have the sketch independent, you can do it this way. Right click on the Copy/Paste New component and select Save Copy As. This creates an External file. You can then save your assembly, if not already done, Insert the External file into the assembly and then Break Link to the original. The sketch of this component, even though created from the Copy/Paste New operation, when edited remains in the location of the component and does not revert back to the original it came from.
John Hackney, Retired
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@kmanuele wrote:
When I create a new component, I can just move its origin before adding any features.
Once there are contained sketches and/or bodies, it seems the origin can't be moved (?).
You can move or change the Origin of a component anytime you desire. Simple edit the base sketch of the component and move or change its relationship to the Origin of the component.
Just seems weird that the origin and its sketches stays with a component when moving it around but jump back to their point of creation for editing. Not clear at all why "edit in place" can't be done.
This is the way the application works, you will get used to it or use another modeling process.
John Hackney, Retired
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@kmanuele - you talk about "moving the component's origin". I am not sure what you mean by that. Are you talking about moving the component (which moves the component's origin, and any geometry within that component, with respect to the global origin), or moving the geometry within the component, with respect to its origin? Each component has its own origin, and there is a global component, which also has its own origin. Can you illustrate your questions with some examples/video?
Jeff Strater
Engineering Director
Pay attention to the timeline. When you move a component, then capture that position, it adds a "capture" feature to the timeline. If you add a sketch after the capture, then edit that sketch, the component will not appear to move to its old position However, if you add the sketch then move the component, then editing the sketch will "roll back" to the point in time when that sketch was created, and so will position the timeline before the move, which will appear to you as if the component has moved to its old position. In the video below, I show both - adding the sketch before the move and after the move. Hope this helps
Jeff Strater
Engineering Director
@kmanuele wrote:
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I think this is referred as the "profile sketch" ? This seems to have a special role in Fusion360 vis-a-vis other sketches.
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There is no specific "profile sketch" in Fusion 360 and no "special" behavior.
When you copy/paste-new a component and edit the original sketch, the position will seemingly it will return to the position that sketch was originally created and this is with the original component.
If there would be a second sketch in the original component that behavior would be the same.
This is something I have gotten used to, but in the beginning having worked in other CAD system (15+ years of SolidWorks) I also found this irritating. One way to battle this is to select the sketch in the browser and select "show dimensions". If you simply want to change dimensions, you can do that without "editing" the sketch. In that case things remain in place.
Do not use any of the basic (Box, Cylinder, Sphere) 3D primitives as they are only semi-parametric. Use sketches and extrudes / revolves to create you're base geometry.
