can't move a sketch
If a constraint is visible, you can just select it and hit the Delete key.
It does matter how you select objects to be moved- you may need to select all lines defining a shape, rather than the profile it creates, to use Move.
- Ron
Mostly Mac- currently M1 MacBook Pro
Mostly Mac- currently M1 MacBook Pro
If you sketch a line, and snap it to another sketch element or an object, Fusion automatically applies a constraint. Most would regard that as an important feature, and I don’t think there is any way to turn it off. But you can delete the constraint after the fact if you later want to move the object. Deleting any visible constraint is an action of simply selecting and pressing Delete.
A separate issue is a “hidden” constraint- such as you get when you draw a circle at the origin point. In that case left clicking on the point will bring up the “delete coincident” option, as described in post #5 here. Make sure you are using the Select tool when you select the center point with a left click, move outside the circle, then right click to get this menu.
After you delete the coincident constraint the circle can be moved freely. I tend to think hiding those constraints makes the Fusion interface harder to understand- I believe there was an Idea Station post related to this.
What applications are you comparing Fusion to? I don’t find moving objects in Fusion to be particularly difficult compared to other CAD programs I have used. But you do need to get used to the way Fusion handles constraints and the limitations imposed by the parametric environment, if that is not familiar to you. And there are quirks, like the hidden constraints, that are unnecessarily confusing.
- Ron
Mostly Mac- currently M1 MacBook Pro
Mostly Mac- currently M1 MacBook Pro
That idea is there already!
Search the idea station for sketch block or sketch groups and throw your vote in the hat.
Thanks for the video. Unfortunately, there is no tutorial that I'm aware of. You've figured out the problem - if you select geometry that is either fixed or projected, you won't be able to move anything. I tend to avoid window select with sketch move, because you get everything. While it's a bit painful, I tend to just select the geometry I want to move one at a time.
You could write an add-in to select only unfixed or non-reference geometry, but I'm not sure it's worth the effort.
There are a few things we could certainly do in Fusion to make this easier. I've seen a request to just be able to unfix all the fixed geometry in a sketch. The problem is that Fix/Unfix is a toggle. So you can't just do a window select and unfix everything. That would also be relatively easy to do in an add-in.
Sorry I can't be of more help.
Jeff
Jeff Strater
Engineering Director
The attached is only very lightly tested, but does work on simple cases. It will unfix all fixed geometry in the active sketch, or in a sketch selected in the browser. Caveat emptor...
Jeff
Jeff Strater
Engineering Director
more than likely, this is because there is projected (reference) geometry in this sketch. Hard to say without the model. Let me modify the script to handle that...
What this won't do is to remove any dimensions between the selected geometry and any external geometry. In your case, though, you want to move everything, so this should not be a problem
Jeff
Jeff Strater
Engineering Director
Hi @simon.dyer,
Here are two more versions of the script. The first one ("unfix all geometry") is the same one I sent yesterday, but also handles doing "break link" on projected geometry. As in the one yesterday, this will make all the sketch geometry in the sketch (either the active sketch if you're in sketch mode, or the selected sketch). The second ("unfix selected geometry") has the added feature of, if you are in sketch mode, you can select a subset of the geometry, and it will only unfix/break link on that geometry. Note that this will not always guarantee that the sketch can move (there can still be dimensions to other fixed/reference geometry).
As before, I didn't spend a lot of time on this. Probably needs some polish, and as with any software, there are no doubt bugs in it...
Jeff
Jeff Strater
Engineering Director
Great introduction of yourselves yelling around in a forum with your first post!
What do you want fixed ?
@Anonymous I've flagged this to the discussion_admin as inappropriate as it includes rude insults and does not add anything to the topic. I strongly suggest you read the Forum rules before your next post!