iLogic - turn on/off parts

[jmckone9Z5PD]

Recently, I have been experimenting with iLogic to (hopefully) simplify some window assemblies and the various options within.

I have a window type that has 3 exterior size options, 5/8", 2" and 3.5" cladding.   A user parameter called 'Exterior_Options" has been created with the three size options (multi-variable list).  The tutorial video that I am using as a guide uses the function:

Feature.IsActive("Part1:1", "featurename")

 This does not seem to be the correct function as I am not trying to turn on/off a feature within the part, but the actual part in the assembly.  My guess is the logic should look like:

(repeated for 2 and 3 1/2 and with something like Part.IsActive (or example)):

If Exterior_Option = "5/8" Then
	Feature.IsActive("1201-P Mainframe Head & Sill .625") = True
	Feature.IsActive("1201-P Mainframe jamb .625") = True
	Feature.IsActive("1201-P Mainframe Head & Sill 2") = False
	Feature.IsActive("1201-P Mainframe jamb 2") = False
	Feature.IsActive("1201-P Mainframe Head & Sill 3 1/2") = False
	Feature.IsActive("1201-P Mainframe jamb 3 1/2") = False

[kacper.suchomski]

Hi

Parts and subassemblies are components, and their state is managed by the command

Component.IsActive("Part1:1")

[jmckone9Z5PD]

I made the change from from Feature.IsActive to Component.IsActive which now works.  Is there any way to use the folder rather than the parts?

[kacper.suchomski]

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@jmckone9Z5PD wrote:

I made the change from from Feature.IsActive to Component.IsActive which now works.  Is there any way to use the folder rather than the parts?

---

No. Folders are a UI element; they aid the user in navigation. Folders are not a structural element of the project.

[jmckone9Z5PD]

I expected as much but wanted to be sure.  Now that I have some basic idea of how things work, I will look for a tutorial to get a better understanding of what the functions do.

Thanks for the help.

[Curtis_Waguespack]

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@jmckone9Z5PD wrote:

 Is there any way to use the folder rather than the parts?

---

@jmckone9Z5PD , here's are a couple of quick API examples you can use in an iLogic rule. 

Hope that helps, Curtis

 toggle suppression of all components in the folder on/off.

Dim oPane1 As BrowserPane = ThisDoc.Document.BrowserPanes("Model")
Dim oFolder As BrowserFolder = oPane1.TopNode.BrowserFolders.Item("MyFolder")
Dim oFolderNodes = oFolder.BrowserNode.BrowserNodes
Dim oOcc As ComponentOccurrence

For Each oNode As BrowserNode In oFolderNodes
	oOcc = oNode.NativeObject
	'toggle on/off
	Component.IsActive(oOcc.name) = Not Component.IsActive(oOcc.name) 
Next

 suppress all in folder

Dim oPane1 As BrowserPane = ThisDoc.Document.BrowserPanes("Model")
Dim oFolder As BrowserFolder = oPane1.TopNode.BrowserFolders.Item("MyFolder")
Dim oFolderNodes = oFolder.BrowserNode.BrowserNodes
Dim oOcc As ComponentOccurrence

For Each oNode As BrowserNode In oFolderNodes
	oOcc = oNode.NativeObject
	'turn off
	Component.IsActive(oOcc.name) = False
Next

[jmckone9Z5PD]

This is interesting.  It would save a lot of work since most options are arranged by folder.

I will give this a try in a few days when I finish my current experiment with iLogic.

I appreciate that my original post was forwarded to the programming form, and an reply was promptly received.

[WCrihfield]

Here is just another way to 'Toggle' the suppression status of all components in a browser folder in an assembly.  This also first gets the browser folder, but then, instead of iterating through each item within it, it just selects that folder, and runs a 'command' on it.  This way of doing things is more like 'simulating user interactions' than it is true iLogic or API, so not as controlled, but still useful sometimes.  Because when we manually select that folder, and right-click, we have that command in the context menu.  This will only work with the currently 'active' document though, not on referenced documents in the background.

Dim oDoc As Inventor.Document = ThisApplication.ActiveDocument
Dim oPane As BrowserPane = oDoc.BrowserPanes.Item("Model")
Dim oFolder As BrowserFolder = oPane.TopNode.BrowserFolders.Item("Group1")
oDoc.SelectSet.Clear()
oFolder.BrowserNode.DoSelect()
ThisApplication.CommandManager.ControlDefinitions.Item("AssemblyCompSuppressionCtxCmd").Execute()
oDoc.SelectSet.Clear()

[jmckone9Z5PD]

Within the assembly drawing there is the 'Default' view and a newly created 'iLogic' view that will be used to create drawing sections.  Is there some way to fix the 'Default' view so when section drawing are created the 'Default' view is not changed?