Hide all UCS and Work Feature in every component from Top assembly

[tim11_manhhieu]

Hi all,  like as title, i want to hide all User Coordinate System and work feature sketch, axis, plane, point in sub assembly, part in sub assembly, every component.

[Stakin · Accepted solution]

AssemblyDocument.ObjectVisibility Property

Parent Object: AssemblyDocument

Description

Property that returns the ObjectVisibility object providing override visibility controls for objects in the document. Changes are not saved with the document.

Syntax

AssemblyDocument.ObjectVisibility() As ObjectVisibility

Property Value

This is a read only property whose value is an ObjectVisibility.

AssemblyDocument.ObjectVisibility.AllWorkFeatures=False

AssemblyDocument.ObjectVisibility.UCSTriads=False

[tim11_manhhieu]

amazing, many thanks.

AssemblyDocument.ObjectVisibility.AllWorkFeatures=False
AssemblyDocument.ObjectVisibility.UCSTriads=False

[tim11_manhhieu]

Sorry, how can I turn on UCS, WorkFeatures manually?

Even though I have checked Visibility, the icon on the model tree still does not light up.

[Stakin]

ObjectVisibility Object

Description Properties

Name	Description
AllWorkFeatures	Gets and sets whether all work features should be visible.
Annotations3D	Gets and sets whether 3d annotations should be visible.
Application	Returns the top-level parent application object. When used the context of Inventor, an Application object is returned. When used in the context of Apprentice, an ApprenticeServer object is returned.
ComponentAnnotations3D	Gets and sets whether component 3d annotations should be visible.
ConstructionSurfaces	Gets and sets whether construction work surfaces should be visible.
GroupDiagnostics	Gets and sets whether group diagnostics should be visible in the construction environment of parts.
GroupSolids	Gets and sets whether group solids should be visible in the construction environment of parts.
GroupSurfaces	Gets and sets whether group surfaces should be visible in the construction environment of parts.
GroupWires	Gets and sets whether group wires should be visible in the construction environment of parts.
OriginWorkAxes	Gets and sets whether origin work axes should be visible.
OriginWorkPlanes	Gets and sets whether origin work planes should be visible.
OriginWorkPoints	Gets and sets whether origin work points should be visible.
Parent	Property that returns the parent Document object.
SketchDimensions	Gets and sets whether sketch (2D/3D) dimensions should be visible.
Sketches	Gets and sets whether 2d sketches should be visible.
Sketches3D	Gets and sets whether 3d sketches should be visible.
Type	Returns an ObjectTypeEnum indicating this object's type.
UCSTriads	Gets and sets whether user coordinate system triads should be visible.
UCSWorkAxes	Gets and sets whether user coordinate system work axes should be visible.
UCSWorkPlanes	Gets and sets whether user coordinate system work planes should be visible.
UCSWorkPoints	Gets and sets whether user coordinate system work points should be visible.
UserWorkAxes	Gets and sets whether user work axes should be visible.
UserWorkPlanes	Gets and sets whether user work planes should be visible.
UserWorkPoints	Gets and sets whether user work points should be visible.
WeldmentSymbols	Gets and sets whether weldment symbols should be visible.
Welds	Gets and sets whether welds should be visible.

[tim11_manhhieu]

thank you

[WCrihfield]

Just to add some additional context...the ObjectVisibility object mentioned here coincides with a tool you can manually access from Inventor's ribbon.  On the 'View' tab, within the 'Visibility' panel, is a button with a drop-down control named 'Object Visibility'.  When you click that drop-down, you will see all these same object types, with checkboxes next to them.  Even though these settings are accessed from the main ribbon, they only effect the document that is 'active' when you set them.  And as already mentioned, I don't believe those settings get saved to that document's file.

On the other hand, when you right-click on a UCS in the model browser tree of an assembly, and choose the 'Visibility' control, that is actually changing its visibility in a way that will be saved by the currently active view representation (DesignViewRepresentation ), in the assembly, and possibly in the referenced model document also.

[tim11_manhhieu]

thanks for explaining.

[Stakin]

https://forums.autodesk.com/t5/inventor-programming-ilogic/show-hide-ucs-triad-origin-planes-sketche...