Exporting user text parameters to custom I properties
Do you want to export all text parameter values to iProperties of the same name, or just a specific text Parameter to an iProperty?
If you plan on doing just a specific Parameter to an iProperty, will you need to do this across multiple parts, or is it just a onetime thing for something that you're doing.
This will all influence the code in some way.
If my solution worked or helped you out, please don't forget to hit the kudos button 🙂
iLogicCode Injector: goo.gl/uTT1IB
Oh man! I must be honest. Right around the time of you posting this, work became crazy busy and I... forgot about it 😕
To get a custom iProperty to autoupdate with the value of a text parameter, it could be as simple as adding a single line of iLogic code to the part :
iProperties.Value("Custom", "VeryCustomProperty") = TestText
TestText being a multivalue Text parameter contained in the template part, and VeryCustomProperty being a custom iProperty that is also in the template part.
In this way you would set up your drawing part's list to pull from the custom iProperty 'VeryCustomProperty', which would display the value for the given part it was tied to.
Because I'm not 100% sure if this is what you are wanting to do (only), give me some feedback and we'll continue from there. Now that things have calmed down here (due to winter time), I won't leave you out in the cold 😞
Sorry!
If my solution worked or helped you out, please don't forget to hit the kudos button 🙂
iLogicCode Injector: goo.gl/uTT1IB
Accepted solution
Hi MDS-MQ
Here's a quick example rule I had on hand that creates parameters and then formats them as custom iProperties. ExposedAsProperty creates the iProperty from the parameter, the rest is just formatting it.
I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com
Imports Inventor.UnitsTypeEnum
Dim oParams As Parameters
oParams=ThisDoc.Document.ComponentDefinition.Parameters
Dim oUserParams As UserParameters
oUserParams=oParams.UserParameters
'look for user parameter and try to set it
Try
oUserParams("SM_Length").Value = SheetMetal.FlatExtentsLength *2.54
Catch
' assume error means not found and create it
oUserParams.AddByValue("SM_Length", SheetMetal.FlatExtentsLength *2.54, kInchLengthUnits)
End Try
'create list of parameters to format
Dim myArrayList As New ArrayList
myArrayList.add("SM_Length")
myArrayList.add("Thickness")
Dim oString as Object
Dim oParam As Parameter
Dim oFormat As CustomPropertyFormat
i=0
For Each oString in myArrayList
myParam = myArrayList.Item(i)
oParam = oParams(myParam)
oParam.ExposedAsProperty = True
oFormat = oParams(myParam).CustomPropertyFormat
oFormat.PropertyType=Inventor.CustomPropertyTypeEnum.kTextPropertyType
oFormat.Precision=Inventor.CustomPropertyPrecisionEnum.kSixteenthsFractionalLengthPrecision
oFormat.ShowUnitsString = True
oFormat.Units = "in"
i= i+1
Next
'set the description to read in the iProperties
iProperties.Value("Project", "Description") = "= SH <Thickness> x <SM_Length>"
'update the file
iLogicVb.UpdateWhenDone = True
