Decal in non-shaded drawing view

[Simon22]

I'd like to be able to show a decal's detail on an assembly drawing without having to shade the whole view.

In the attached image item 32 is a label but obviously only the outline is going to show on a non-shaded view.

Is there a work around to this?

Many thanks,

Simon

[CCarreiras]

Hi!

Just looking for the attached picture.... you can select the lines you don't want and set the visibility off them.

Without seeng the propper image, we can say more... 

[Simon22]

Thanks for the reply but that's not what I want to do. I want to see the detail of the decal.

Thanks,

Simon

[CCarreiras]

Well... in that case you must have a rendered view.

Workaraound:

create a view representation with all parts white an set that view representation in the drawing view.

It works, i use this process sometimes.

[CCarreiras]

Check those to get some ideas...

https://forums.autodesk.com/t5/inventor-forum/how-to-present-the-image-without-doing-the-shaded-view...

https://beinginventive.typepad.com/being-inventive/2011/05/assembly-view-partially-shaded.html

[mcgyvr]

For that specific decal I would create it as a part and extrude the shapes/text,etc... so its not a decal at all..

I do that with 100% of our labels due to this limitation of Inventor.

Every one is done with sketch geometry and text extruded .001" so that it shows up in drawings/renderings,etc...

Same with silkscreens applied to our faceplates,etc...

I quickly saw the limitations of decals and ran from them as fast as I could before I fell down that hole..

May I also remind you and anyone else that I have submitted an idea request to allow decals to be shown in other views besides shaded..

https://forums.autodesk.com/t5/inventor-ideas/show-decals-in-all-drawing-view-styles-not-just-shaded...

Please show your support by voting it up.. 

[jtylerbc]

Added my vote to the idea.  Most of the time when I have decals, I'm planning on showing the views as Shaded anyway, so it isn't a problem.

We have a library of common label parts, which were created by adding decals of the label images from the supplier's website.  This was a great way to build the library quickly, looks great, and works fine in cases where we are shading the drawing views (which, as I mentioned, covers most of our uses).  In the rare case where I do actually need a line view, it's a significant problem that usually requires me to redraw the label as you described.

Would be great to have this resolved to give us more options for how to use this feature.

[SBix26]

Possible workaround for you: overlay view.  Create View Representations in the assembly of the decal alone, and all the other parts without the decal.  Place a view in the drawing using the "all the other parts without the decal" VR, making it one of the line drawing types.  Create an overlay view using the "decal alone" VR, and setting the view type to Shaded.

This is not a perfect solution because lines of the two views show through each other.  But if your view happens to be pretty simple, with no features behind the decal, it works (at least in 2019).

Edit: this requires, of course, an assembly (no overlay view available for a part).  See example below:

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Sam B
Inventor Pro 2019.3 | Windows 7 SP1
LinkedIn

[Simon22]

Thanks for your help Sam @SBix26.

I think this is probably the right work around for me - if I can get it to work - it looks like the scale screws it up though (see attached image) and I can't create a detailed view of the overlay.

Hopefully it's something that will get looked at in future releases.

Regards,

Simon

[SBix26]

Hmmm... that's not how it's working for me.  No matter what scale my view is, the decal still renders in good detail.  What scale is your drawing view?  Can you post the assembly/parts/image?

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Sam B
Inventor Pro 2019.3 | Windows 7 SP1
LinkedIn