Any tips on hardware settings (graphics, memory, etc.) that noticeably improve responsiveness in Inventor?

[chammmoy]

Any tips on hardware settings (graphics, memory, etc.) that noticeably improve responsiveness in Inventor?

[CGBenner]

@chammmoy 

Welcome to the Inventor forum.  Can you tell the group what sort of problems you are having that you are trying to solve?  Also, what version of Inventor do you use, and maybe tell us a little about what hardware you currently have in place?  Thanks, and good luck!

[mluterman]

If you're asking that question, then you probably need a new computer. In my experience, any other "tweaks" will give minimal improvement in responsiveness.

[swalton]

Use the Shaded or Shaded with Edges view style.  Turn off the ground shadow and the sketch grid.

Hide all workfeatures unless you need them for the work you are doing right now.

Try not to have any transparent models.

Don't model threads or welds.

Avoid assembly-level features.

Fully constraint all sketches and assemblies.

Fix all "Red Cross" issues in your models.

Avoid associative part features.

Minimize cross file dependencies.

Leverage feature patterns instead of repeating geometry in sketches.

Minimize the surface facets in your models: If you can't see that 0.010" fillet radius on the 60' long beam, don't model it.

Use design view reps or model states to create focus areas in large designs.  Think about the geometry you need to see on screen to accomplish the design task.  Create a view rep to hide the geometry you don't need.

[johnsonshiue]

Hi! You may want to take a look at InvMark (https://invmark.cadac.com/#/) to compare your hardware with other Inventor users. There is an ongoing discussion on the forum about hardware performance.

https://forums.autodesk.com/t5/inventor-forum/how-fast-is-your-inventor-pc-really/m-p/5950908

Many thanks!

[jake_egley]

If using windows, make sure power mode is set to best performance and energy saver is off. My laptop is about 50% slower in inventor with energy saver on or with the power mode in best efficiency.

[JDMather · Accepted solution]

@chammmoy 

The biggest hit on performance that I see from users is computationally expensive sketching techniques.

(This issue is across different parametric CAD softwares - not unique to Inventor.  Sketch constraint solving is complex. Keep your sketches simple.)

They purchase new hardware and then complain that Inventor is still slow.

Keep sketches simple and fully defined.

Mostly avoid Patterns in sketches (use Feature, Body or Component Patterns instead).

Mostly avoid Mirror in sketches (mirror is another type of pattern).  There are more computationally efficient techniques like midpoint constrained construction lines.