Inches/min value when it should be Inches/rev

[Cebrus]

When I post, drilling functions are in Inches/revolution mode, but the F value is the Inches/minute value in the tool selection  menu. I am using the Generic Fanuc Mill/Turn post processor, which is attached to this post. Here is a screenshot of the output code:

[serge.quiblier]

Hello @Cebrus 

when you create an operation for a turn mill machine, sometime you can select the feed rate mode, sometimes you can't.

If we look closer, in a turning operation, we have a switch to select between unit per minute, or unit per revolution.

when we create a milling operation, we don't have any choice:

when creating a drilling operation, we can be thinking that unit per revolution will be used.

But there is not switch to clearly select one or the other mode.

In fact, when Fusion passes the data to the post engine, it always sends unit per minute as the dump file, created by the dumper post, can show us.

And if we look at the resulting gcode

The spindle speed is 4000 rev/minute, the feedrate in Fusion was set to 0.1mm/rev, but passed as 4000 * 0.1 = 400mm/min.

The feedrate mode "forced" by Fusion is G98 which is unit per minute, and NOT unit per revolution.

So, the post should NOT have outputted a feedrate in mm/rev.

I can understand that you MAY have preferred, to be able to choose the feed mode, in Fusion.

In the current state of the software, this is not something possible now.

Regards

______________________________________________________________

If my post answers your question, please click the "Accept Solution" button. This helps everyone find answers more quickly!