Does anyone have a really good Hurco turning post? The generic one gets by for the time. But there is a lot I would like to do on it before we sell the machine.
Thank you,
Garret
Solved! Go to Solution.
Solved by Laurens-3DTechDraw. Go to Solution.
@Anonymous wrote:
Does anyone have a really good Hurco turning post? The generic one gets by for the time. But there is a lot I would like to do on it before we sell the machine.
Thank you,
Garret
What would you want to change?
Is it mostly the formatting? Or actual code changes?
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
Both a lot of the mcodes don't match with the what the post generates. I find myself going thru and changing constantly. Pretty sure it is very simple, but not sure where to start on it.
later today I'll post the code for example and show edits for what I'm talking about
Here is where the machine controller has an issue,
What it posts,
T0606
G98
G97 S800 M3
G0 X0. Z0.6
G17 ( The G17 in drill cycle makes the machine alarm out)
G0 Z0.2
Z0.6
Z0.2
G81 X0. Z-0.22 R0.18 F2.4
G80
Z0.6
G28 U0. W0.
.
.
.
.
(PART1)
G99
G97 S1200 M3
G0 X1.8 Z-2.386
( Would like to see a Part Catch Activate right here M58 for Hurco)
G1 X-0.063 F0.003
( Would like Part Catch retracted M59 for Hurco)
X1.8
G0 Z0.
Here is what works after edit
T0606
G98
G97 S800 M3
G0 X0. Z0.6
Z0.2
G81 X0. Z-0.22 R0.18 F2.4
G80
Z0.6
G28 U0. W0.
.
.
(PART1)
G99
G97 S1200 M3
G0 X1.8 Z-2.386
M58
G1 X-0.063 F0.003
M59
X1.8
G0 Z0.
Here is a few changes would make all the difference
Didn't get a chance to actually post code with it but this should help.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
Everything worked great so far, the only thing is the part catcher does not activate when programmed in the software, Any way to fix that?
Put all the logic in there but forgot the "activate" it.
Sorry.
Try the attached one.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
Perfect! That works in the mean time. There are some other things like the threading but I don't have a part for the example yet. that will come later on to try to see what is going on.
@Anonymous wrote:
Perfect! That works in the mean time. There are some other things like the threading but I don't have a part for the example yet. that will come later on to try to see what is going on.
The post is set-up for threading when you select useCycle in the Threading operation.
By default it would use G92 threading cycle, might not be the most elegant cycle but it should work fine.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
That is the problem. G92 on a Hurco lathe is not threading
This is for a tapered thread
Hurco G-Code
G00 M Linear Motion at Rapid G01 M Linear Motion at Feed G02 M Clockwise Circular Motion at Feed G03 M Counterclockwise Circular Motion at Feed G04 Dwell G06 M Probe/Block Skip G07 M Radius Programming G08 M Diameter Programming G09 Exact Stop G20 M Inch Mode G21 M Millimeter Mode G33 Threading G40 M Cutter Radius Compensation Off G41 M Cutter Radius Compensation Left G42 M Cutter Radius Compensation Right G53 M Program Machine Coordinates G59 M Cancel Work Coordinate Offsets G73 M Peck Drill with Chip Break Drill Cycle G74 M Left Hand Tapping G78 Threading Cycle G80 M Cancel Drill Cycle G81 M Drill Cycle G82 M Drill Cycle with Dwell G83 M Peck Drill Cycle G84 M Right Hand Tapping G90 M Absolute Programming G91 M Incremental Programming G92 M Work Coordinate Offsets or Spindle Max Speed G94 M Feed per Minute G95 M Feed per Revolution G96 M Constant Surface Speed (CSS) G97 M Direct Spindle Speed G98 M Drill Cycle Initial Level Return G99 M Drill Cycle R Plane Return
This is what worked along time ago when we used Mastercam
(TOOL - 2 OFFSET - 2) (ID THREAD - MIN. .5 DIA. INSERT - NONE) ( ID THREAD 1/2 NPT )G0 T0202 G97 S100 M03 G0 G54 X.588 Z.2269 M8 X.7509 G99 G32 X.7035 Z-.5343 E.07143 G0 X.588 Z.2227 X.7661 G32 X.719 Z-.5343 E.07143 G0 X.588 Z.2185 X.7813 G32 X.7344 Z-.5343 E.07143 G0 X.588 Z.2143 X.7965 G32 X.7499 Z-.5343 E.07143 G0 X.588 Z.2101 X.8117 G32 X.7654 Z-.5343 E.07143 G0 X.588 Z.2058 X.8269 G32 X.7808 Z-.5343 E.07143 G0 X.588 Z.2016 X.8421 G32 X.7963 Z-.5343 E.07143 G0 X.588 Z.2 X.848 G32 X.8023 Z-.5343 E.07143 G0 X.588 Z.2 X.848 G32 X.8023 Z-.5343 E.07143 G0 X.588 Z.2269 M9 G28 U0. W0. M05
Not sure what to do to get it close to this
@Anonymous
I updated your post.
Please test very carefully.
The Pitch output might be wrong if you run in Inch. (I think MM is good)
This output will only be generated if you leave UseCycle option in the Threading operation off, it will give an error when you have that on.
Let me know if it works.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
Ok sounds good ill test it, later on, today and give you feedback on how it worked out.
Looked good so far, but never know on this Hurco.
BTW your sample shows G32 while the manual says G33.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
Your a superstar @Laurens-3DTechDraw
Can't find what you're looking for? Ask the community or share your knowledge.