Fusion
Community
Hello,
I used a 2D Adaptive and the feed rates are all over the place for some reason. I'm using the Haas ST20Y post on that machine.
Thanks in advance!
Allan
Hello,
I used a 2D Adaptive and the feed rates are all over the place for some reason. I'm using the Haas ST20Y post on that machine.
Thanks in advance!
Allan
Hi Allan,
Can you export your project as a .F3D file and attach it here?
Neal Stein
New to Fusion 360 CAM? Click here for an introduction to 2D Milling, here for 2D Turning.
Find me on:
Instagram and YouTube
New to Fusion 360 CAM? Click here for an introduction to 2D Milling, here for 2D Turning.
Find me on:
Instagram and YouTube
Hi Allan,
Can you export your project as a .F3D file and attach it here?
Neal Stein
New to Fusion 360 CAM? Click here for an introduction to 2D Milling, here for 2D Turning.
Find me on:
Instagram and YouTube
New to Fusion 360 CAM? Click here for an introduction to 2D Milling, here for 2D Turning.
Find me on:
Instagram and YouTube
It seems you are running in what we call XZC-mode. The post processor calculates the C-angle and X-value. The haas posts automatically switchs to degrees/min feedrate when entering this mode. This is to maintain the correct feedrate on the machine.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
It seems you are running in what we call XZC-mode. The post processor calculates the C-angle and X-value. The haas posts automatically switchs to degrees/min feedrate when entering this mode. This is to maintain the correct feedrate on the machine.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
Let's tag @AchimN as I believe he was involved with making these posts. He can explain this most probably.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
Let's tag @AchimN as I believe he was involved with making these posts. He can explain this most probably.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
In the mean time check out this PDF.
Page 46 explains this. By default your machine will probably calculate the speed based on a certain diameter given in parameter setting 102.
But that's very inconvenient for machining on various diameters.
Therefore the post outputs deg/min. But you probably have to setup your machine to do so.
It also seems there is a way to set setting 102 from the post processor properties.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
In the mean time check out this PDF.
Page 46 explains this. By default your machine will probably calculate the speed based on a certain diameter given in parameter setting 102.
But that's very inconvenient for machining on various diameters.
Therefore the post outputs deg/min. But you probably have to setup your machine to do so.
It also seems there is a way to set setting 102 from the post processor properties.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
Where does this metric switch come into play?
I'm pretty lost in your last reply.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
Where does this metric switch come into play?
I'm pretty lost in your last reply.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
Well yes.
Because there isn't really another option because of control limitations. Or you would constantly, read for every line, need to change setting 102.
Btw, The reason the post uses XZC values instead of G112 is another control limitation. If you get close to/through the center of X, Haas control can't handle that. So the post needs to go to XZC.
But looking into the post it might seem you just need to input your machine's 102 setting into the post properties. So the post does some calculation to be correct even though the control can't handle this properly. So what you see is the post calculation the value it needs to feed into the control, so its calculation makes it correct again. At least that's the look of it in the latest posts.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
Well yes.
Because there isn't really another option because of control limitations. Or you would constantly, read for every line, need to change setting 102.
Btw, The reason the post uses XZC values instead of G112 is another control limitation. If you get close to/through the center of X, Haas control can't handle that. So the post needs to go to XZC.
But looking into the post it might seem you just need to input your machine's 102 setting into the post properties. So the post does some calculation to be correct even though the control can't handle this properly. So what you see is the post calculation the value it needs to feed into the control, so its calculation makes it correct again. At least that's the look of it in the latest posts.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
Accepted solution
Figured it out!
Just have to turn "Use Polar Interpolation" to YES!
Holy S#!T I was about to lose my mind on this!
Figured it out!
Just have to turn "Use Polar Interpolation" to YES!
Holy S#!T I was about to lose my mind on this!
@AllanVarcoe wrote:
Figured it out!
Just have to turn "Use Polar Interpolation" to YES!
Holy S#!T I was about to lose my mind on this!
As long as you don't go near the center of the part this works indeed. But I assumed that was purposely turned off because of that.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
@AllanVarcoe wrote:
Figured it out!
Just have to turn "Use Polar Interpolation" to YES!
Holy S#!T I was about to lose my mind on this!
As long as you don't go near the center of the part this works indeed. But I assumed that was purposely turned off because of that.
Laurens Wijnschenk
3DTechDraw
AutoDesk CAM user & Post editor.
René for Legend.
Forums Links
Can't find what you're looking for? Ask the community or share your knowledge.
Post to forums
