need help on how to program double driven tool in a Mazak lathe in y axis that on 1 station

[sam_coull]

hi all looking for some help we currently have a 250 smooth control msy mazak lathe and have double driving tool holder for the machine picture attached below of the holder i am talking about.

also attached is the tool data page tool 7 is the double and they are lolly pop cutter and and endmill if want to know 

cant seem to figure out how post both tool on 7 station. using fusion 360 msy 250 post in library.

how to get it to read or call out tool station but example 7a lolly pop tool and 7b the end mill as i see only tool 7 so don't know which one it will choose 

has any one played with this type of tooling on fusion and got it to work any help be greatly taken as mean can get part off more complete using these holders

[seth.madore]

Yes, I have a similar tool in my Doosan Lynx (except they're ER16).

The first will be T707 and the second would be T727 (or whatever turret station number you prefer and increment). If I recall, mine require an M4 command to actually rotate CW

If your machine doesn't use the ISO callout of "turret station + offset number", I would assume it would accept "tool name"?

[sam_coull]

how would that look on the tool page in fusion ? able to screen shot wat u mean ? please or a example 

thanks

[a.laasW8M6T · Accepted solution]

Hi

To use the Mazatrol tool numbers you put the ID Code of the tool in the Product ID field of the Tool In fusion .

See video

[sam_coull]

It makes sense now when some said to update the produced ID of the tool I will give it a go tomorrow with the machine but from what I am getting, the NC code looks good and matches something else they sent me 

I will update you tomorrow once tried it on the machine.

Thanks for the time for a video help much and learned something new and added a new level to the lathe  and the double hold we have and can use

[a.laasW8M6T]

I don't have a Y offset milling tools or subspindle tools, but I do use the ID codes when I'm using more tools than I have stations in a program as I have Quick change tooling on the turret(Capto and EWS Varia)

You can call up any tools offset that's not set as an active tool in the Turret in MDI also.

So MDI>Tool Change> type in 2.6 and it will enter T200.06 into MDI which will call the tool data for Tool: 2 ID: F 

[sam_coull]

so i can confirm with help from a laasw8m6t we got it to work on the lathe with the dual tool holder.

we end up running in iso when we posted it and also had 7 in all the box in last page of tool edit as it need to read the y axis 25 and / -25  then end up put 1=A on the Mazak controller and 2 =(B) in the tool for the product id so we get posted out T0707.01 and T0707.02 and work out really well

so learn some new there and thanks again to a laasW8M6T for his quick video show where the number goes and explain it