Fanuc driling cycles F and Q parameter eror

[CAMtech_Software]

in drilling cycles fanuc post is making mmpr/mmpm error as progress. Live tool selection is disabled in tool definition. The cycles Q value does not come in thousands.

%
O1001
N10 G98 G18
N11 G21
N12 G50 S6000
N13 G28 U0.
N14 G28 W0.

(DELGI1 2)
N15 T0606
N16 G98 G18
N17 G54
N18 M8
N19 G97 S909 M3
N20 G0 X0. Z18.
N21 G0 Z8.
N22 G83 X0. Z-35. R5. Q5. F73.  ( G83 X0. Z-35. R5. Q5000. F0.08)
N23 G80
N24 Z18.

N25 M9
N26 G28 U0.
N27 G28 W0.
N28 M30
%

[CAMtech_Software]

Fanuc 2x turning post

[CNC_Lee]

@CAMtech_Software 

This post will need to be edited and configured properly to achieve the correct output required. If you are not comfortable making these edits, there are professionals who can edit the post to fit your needs! 

[CAMtech_Software · Accepted solution]

I can understand you but this is not customization. Is it a standard feature for Fanuc turning and a problem in F360?

[Arun.rs · Accepted solution]

HI @CAMtech_Software 

This support requires the allowFeedPerRevolutionDrilling variable to be set to true so that the post engine knows that the post processor will accept FPR feedrates plus other logic to output the correct feedrate mode code and the proper feedrate number.

minimumChordLength = spatial(0.25, MM);
minimumCircularRadius = spatial(0.01, MM);
maximumCircularRadius = spatial(1000, MM);
minimumCircularSweep = toRad(0.01);
maximumCircularSweep = toRad(180);
allowHelicalMoves = false;
allowedCircularPlanes = 1 << PLANE_ZX; // allow ZX plane only
allowFeedPerRevolutionDrilling = true; >>>>>>>>>>>>>>> Add this here

Regards

[Arun.rs · Accepted solution]

HI @CAMtech_Software 

The Q value to come in thousands, enable the second 'var peckFormat' in post,

//var peckFormat = createFormat({decimals:(unit == MM ? 3 : 4), forceDecimal:true});
var peckFormat = createFormat({decimals:0, forceDecimal:false, trim:false, width:4, zeropad:true, scale:(unit == MM ? 1000 : 10000)});

Regards

[CAMtech_Software]

Going too far as I couldn't see what you wrote. Thanks for the solution. All issues have been resolved

%
O1001
N10 G98 G18
N11 G21
N12 G50 S6000
N13 G28 U0.
N14 G28 W0.

(DELGI1 2)
N15 T0606
N16 G99 G18
N17 G54
N18 M8
N19 G97 S909 M3
N20 G0 X0. Z18.
N21 G0 Z8.
N22 G83 X0. Z-35. R5. Q5000 F0.08
N23 G80
N24 Z18.

N25 M9
N26 G28 U0.
N27 G28 W0.
N28 M30
%