Fusion
Either deletes the chamfer along the corners or gives me the below error:
I've definitely been able to do that before without issue but might have had design history captured while doing so.
Delete Face the existing Chamfer and add a new chamfer.
(Or always work with Capture Design History - in which case simple Edit Feature.)
Nothing has changed here, I am certain. No functionality was removed. If this is imported geometry, it is likely data specific. Fusion has code that is a "chamfer detector". If the geometry does not meet whatever definition of a chamfer it expects, the press/pull tool will not be able to modify it as a chamfer. There have always been models where this is the case. There is always the possibility of a bug, but without the model it is hard to tell...
What happens if you select all the chamfer faces and delete them? Does the model heal correctly? Can you re-add the chamfer, and if you do, does it function as you expect with Press/Pull? (as @TheCADWhisperer suggested). That would be my best recommendation, as well.
Jeff Strater
Engineering Director
I'm confused about why you tried to press/pull the chamfer without selecting all of the chamfer faces. First, you selected only the long faces:
Then, you selected only the corner chamfer faces:
I would not expect either of those operations to work, and I believe they have never worked. The chamfer produces 8 faces. I would expect to select all 8 and to have that work. I don't have Fusion in front of me right now, but I will try to look at it later.
Jeff Strater
Engineering Director
@jeff_strater What might be causing confusion is the difference between fillet and chamfer. With a fillet you can select just one fillet in a chain and it modifies the whole chain when you press pull but chamfer fails! Try the attached STP file.
Here just a single fillet selected.
On this model Fusion will not even let me select the whole chain of chamfers. I've tried preselecting but Fusion unselects most of the chain, tried selecting the chain after starting Press Pull but Fusion will not let me select all chamfers. If I create a selection set I can get it to work so looks like selection could do with some tuning up!
Using a selection set.
Find features doesn't work either, it finds 2 chamfers and trying to modify the chamfers doesn't work.
First chamfer Find Features creates is the top face, doesn't make much sense.
Second chamfer only the straight sections and modifying changes the height of the part not the chamfer.
Mark Hughes
Owner, Hughes Tooling
Did you find this post helpful? Feel free to Like this post.
Did your question get successfully answered? Then click on the ACCEPT SOLUTION button.
