Hi,
I created a sketch and extruded it. Then I wanted to add a fillet with variable radius but this failes:
The startpoint and endpoint got a radius of 0.3 mm. In the middle I wanted to add 12 mm but this failes. 😞
Maximum radius which is working is 5mm.
For testing I duplicated the object and added a fillet with constant radius. And here I can create a 12mm fillet without any problem.
Why the variable radius does only work up to 5mm?
The f360 file is attached.
Thanks...
It looks like the variable fillet is failing where I've highlighted in the image below, the smallest I can get to work in that area is about 2.9mm. You will also find with the constant rad it will fail with a 3mm rad, above and below 3mm it works. Sorry can't explain why, I know why just can't explain. Don't know if adding more points on the variable fillet might get you something you can use.
Mark
Mark Hughes
Owner, Hughes Tooling
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The reason less works is because the fillet doesn't close in on itself, the reason more works is because it eliminates the problem area with a completely different surface.
Just for the record you would get the same results in SolidWorks.
The work around would be to control the fillet to stay smaller in the problem area Mark outlined. I share your frustration in cases like this but to be honest all CAD apps I have used have a problem with cases like this.
Phil Procario Jr.
Owner, Laser & CNC Creations
I think its just a limitation of what's possible. There used to be a rule with CAD you should add big fillets to your model first then smaller ones, trying to fit a 10mm fillet around a 2mm would fail. Cad has got a lot better now and Fusion can usually add a bigger rad around a small rad but it can still fail. In your example with a constant rad above 3mm the the profile of the model is added to the fillet, below 3mm the fillet is added to the model, hope that makes sense. At 3mm you get a sharp corner and I think that just kills the fillet command.
Mark
Mark Hughes
Owner, Hughes Tooling
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The problem is that variable fillet has much more to deal with.
In your example, it cannot deal with the sharp turn and still provide what you are asking for. It just fails.
The key is to make the corner more gentle, or use more control nodes in your variable fillet. You have to help the fillet get around that corner.
Thanks,
Here's a picture that show the smallest radius in the area where the variable fillet fails is 3mm. Making the radius of the curve there bigger or smaller govern how big a fillet you can get away with.
Mark
Mark Hughes
Owner, Hughes Tooling
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Hi everyone, thanks for the great input here.
The solution that @HughesTooling referred to further up ("the reason more works is because it eliminates the problem area with a completely different surface") is known as the blend-too-big solution.
The good news is that we're working on improving the blend-too-big behaviour around the constant radius fillet when the curvature gets too tight (for reference this is ASM-2611). Geometry usually gets tricky in the transition regions, which is why you see the failure at 3mm but success at 2.9mm and 3.1mm, hopefully we can make that more predictable.
@thburn At the moment we don't support blend-too-big for variable fillets and G2 fillets. If that's something you'd like to see in Fusion, can you log a request in the IdeaStation and then post the link here?
Thanks!
Indy
