Paste New Component. All sketches should move with the new Component!

[Anonymous]

There are a ton of questions in the forum regarding the issue of "Pasting NEW components from an existing Component" and the workarounds for solving them from a couple of years ago. This is why I need to ask again if there are any new solutions for this aching problem.

As stated many times, one of Fusion 360's main advertising points is working with multiple components in a hierarchic assembly-tree. There is the option to copy-paste linked Components, which share all features of the original component. There is also the other option to copy-paste Components ANEW without this link and create variations to the new components, which won't transfer to the original. 

The problem is that when you PASTE a Component as NEW the sketches remain at the origin of the initial component.

This would not be a matter if all I needed was to add a new Chamfer or have an extra Cut here and there on the newly pasted Component. But I need the new component to function fully independently and maybe use the surrounding geometry as projections on its sketches. This is impossible, because the sketches counter-intuitively stay to the origin of the initial Component.

I've been reading a lot about this issue and THERE IS A SOLUTION:

You need to SAVE the original self restrained component to a new file and then to INSERT it again into the assembly, find the right spot to move it and to BREAK its LINK to the file.

This in my opinion should be possible without needing to create an extra file with the original component, because it is basically the same (why then have PASTE NEW in the first place ?).

I am in no way an expert and still learning a lot about Fusion. The experience is awesome, most things are done with ease, even having several different ways to do stuff, from which you can chose the optimal ways to do it and there are lots of tutorials online.  I would be happy to know if this issue bothers anyone else and if there is something I'm missing here.

Cheers 

[laughingcreek]

For me, when I PASTE NEW a component, the sketches do move with the component.  Are your sketches in the component?  Can you post your file or a video of this behavior?

[lichtzeichenanlage]

Can you screencast what you're doing and / or File -> Export your design here. I'm not sure what you're doing. 

[TrippyLighting]

You are likely missing something called "component activation". Here's a link to Fusion 360 R.U.L.E #1

[Anonymous]

Just checked again the sketches SEEM to move with the PASTE NEW component. When you highlight them (with the lightbulb icon) they seem to be in the right place with the NEW component, the dimensions are at the right spot too if you make them visible. But the ACTUAL sketch remains at the OLD component when you open it up for editing.

I'm going to record my screen right away to show you.

Edit> the sketches are under the hierarchy of the component of course (I am aware of RULE 1).

[TrippyLighting]

Ok, but please do share the model as well.

[laughingcreek]

When you edit a sketch, the time line moves back to the point the sketch was created.  It's probably moving back before any position captures or applied joints

[Anonymous]

I've made a little sample , so that things stay clear . 

... Notice when I insert the component from a file how the sketch is moved when you open it for editing...
when I paste new, the sketch can only be edited from its original location at the initial component

.... OH no, because the AERO theme of windows is disabled some of the things on screen aren't visible....I will have to reupload

Anyway here is the File if it is of any interest to you:

[Anonymous]

Yes, this is exactly what happens, but PASTE NEW should start a new timeline and move the sketch the same as if you INSERTED the component from a file.

[laughingcreek]

It does start a new timeline, complete with the position capture from the copied component.  then you moved the PASTE NEW component (with out a position capture).  When you edit the sketch, it reverts back to before you moved it.

[Anonymous]

Yes yes, but is there a way to move the sketch apart from saving to a separate file and inserting. 

[TrippyLighting]

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@Anonymous wrote:

Yes yes, but is there a way to move the sketch apart from saving to a separate file and inserting. 

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I've been following this conversation so far.  Why would you want to do that ?

[Anonymous]

Because I want to edit the sketch at its new proper place and add projections from the surrounding geometry to it. 

It's also nice to have it moved for OCD's sake. 

Maybe this thread from 2017 explains it better than me.

https://forums.autodesk.com/t5/fusion-360-support/component-sketches-don-t-move-with-component/td-p

[laughingcreek · Accepted solution]

@TrippyLighting , glad your following, b/c I think I'm lost.

@ivan.dimitrovKUJTA -the first half of this screencast is what I think your seeing.  is the second half what your trying to do?

[Anonymous]

OMG,  you are a genius! Thank you. 

I can't believe it was so simple, I guess I never bothered going to the top level and moving the capture position event after pasting. It was so obvious. Solution accepted. 

[TrippyLighting · Accepted solution]

In general I avoid using the position capture feature in assemblies completely.

On rare occasions ( in my opinion) it can be helpful in modeling things, but for the most part it gets in the way of every day work.

What I mean with "gets in the way" is that usually in order to position coponents in an assembly in reference to each other the joints in the assemble menu should be used. Sometimes, however, an increasingly in more complex assemblies one dos not have access ot the geometry on wants to pick to locate a joint origin.

In these cases you need to capture the position, then create the joint. then the feature can be deleted.

Position capture features when used sparingly can be beneficial, but I've seen designs with dozens of them and most of them were not needed and deleting them resulted in 2 fold speed increases in terms of parametric updates.

[lichtzeichenanlage]

Do you really have to edit the original sketch. Wouldn't it be possible to create a 2nd sketch and alter the component? 

[Anonymous]

Yes, I see clearly now this seems like a problem of my workflow than the actual need for the movement of sketches. Editing a sketch equals going back in the time line and the sketch staying at the original place is a good reminder of that fact.