How to Align a body with origin plane

[taylor.fry]

I have a model that when loaded is floating and space at a weird angle and no side of it is on an X/Y/Z plane.  I was imporitng items into the windows 10 STL reader, letting it use its "settle" feature, then bringing it back in.  

Is there a trick to agetting a face rotated flush with one of the major planes and moved to the origin?

Very new user here...

[Oceanconcepts]

If your imported object has a planar face, the easiest method would be to use the Align command under the Modify menu. Select first the face on the object you want to move, then the plane you want to align with. 

Components in Fusion have their own origins, so be aware that the component’s internal origin might not align with the “world space” planes. 

As far as moving to the origin (or any other point), use the Move tool, and select the manipulator, then set the pivot to the part of the body/component you want to snap to the origin, then select the origin point. It’s an orthographic move, so you may need to select more than one direction. 

Tools all work pretty much the same in Fusion- select the one to move first, then the “go to” point.

[Anonymous]

Let's hope you have a planer face to use! 

This is where showing a dot at the center of extents would yield great results. 

Say you had a sphere that you imported. There is no planer surface to work with. So you can't even use a mid plane construct to slice the sphere(ok you maybe able to if you zoom down to a very uncomfortable level).

Spheres, pebble shapes and organics are hard to work with. 

[Oceanconcepts]

The align tool will provide a snap at the center of a sphere. If you have an irregular organic shape with no planar surfaces you would need to create a construction feature where you want to align- which might not necessarily be the center of extents, though you could make a point there. You would need to make this feature inside the component in the browser, by activating the component before creating the feature. Then use the components option in the align tool- or joints, if that is more appropriate. 

There are many options for creating construction features- using one or more will usually enable a solution. 

[Anonymous]

Ron

I have to find a center of extents a lot when I import a rifle stock. 

I need to do that for nesting purposes. i use the piont at three planes tool. But as the stocks always come in with a OP that is no way here the center and some times canted (the models are redrawn using a scan file as the base) it can take half a day to get them into some workable situation. 

Hence my campaign for a find center of extents tool in the right click on body function. 

I bow to your better knowledge. So I ask how would you make this hard won center piont associative to the imported model? 

Or more rather when you use the aligne tool will the model move along with the  center piont? 

Will the OCS move to the piont? 

I am so interested in this as this could save me a huge amount of time. 

Of course if we could have the tool I suggested, it would be done in seconds. AD allready have the code done for the cam setup side of things. So porting it across should be easy. 

I think this is so needed I am trying to learn Python script to write a plug in for it. But then I know nothing about the API or how to get it done. Having the time to learn well in needs to take its place with everything else. So maybe never. 

[Oceanconcepts]

Have you posted this center of extents idea in the idea station? If you have, let me know and I will vote for it.

To make any construction feature associative:

• Your rifle stock would need to be component.
• The Point would need to be located inside that component- either by activating the component prior to creating the construction feature (best practice) or by dragging the construction feature into the component in the browser. 
• Then when you use the align tool (or move tool), select the component option, and the point in the component you created as the reference. This will result in the entire component moving.
  
  

I’m not sure what OCS means…  I don’t think there is anything that can be done within Fusion to change the origin of an imported (or internally created, for that matter) component, short of essentially placing it in another file, moving the part to where you want the origin to be, and then importing and linking the Fusion file to your design. It would be very useful to be able to do this, and there have been discussions around that. I understand why in Fusion each component is in a sense it’s own world, with it’s own origin, but sometimes it would be nice to be able to change it. Maybe someone has a workaround other than that above. 

[Anonymous]

Hi Ron. 

Yes I have posted the idea. It's is currently the second attempt to gain the ten votes it needs. 

But I don't think it will meet the bar. 

If it fails I will resubmit again with a much more explained post. 

As follows. 

Just imagine.

import a organic shape part so it creates a componant.

then right click on the componant in the tree and click find center of extents.

a piont would show up where the center of the extrems are.

right click componant and click the move function.

in the move menu click move Corordinate triad to piont. 

I see another copy of the part. 

Right click move and select the piont for rotation. 

Move the part 180* spin the part round 180* then with the arrow move the new part down so you can get your cutting tool in between the two parts. 

Then shift and click both the parts. 

Right click find center of extents. And repeat as on the original part. 

Now you have nested two identical parts. With the triad in slap bang in the middle. 

Now in comes another idea I have posted I the ideas section.

shift and click the two componants and then right click them in the tree and click (here's the second idea) properties and have a look at the dimensions of length, width and depth ( not currently in the properties menu!!!!!?). 

You now know what's needed in a sketch to set up a bounding box using the sketch rectangle, center rectangle. 

You have just done in 11 clicks what it takes me almost a morning to do. Plus I have all the sketches I need to get straight into the cam space. 

Its dream workflow. 

But most of the development has been done already! 

Its contained in the set up function in the cam work space. 

At least it looks like it to me. But hey I'm not a coder or a Dev. 

 I call all the tirad the OCS origins Corordinate system! 

I hope that, that explanes what line I'm thinking down. 

Sorry to the OP! 

[jasonwarsalla]

Thank you for that tip, it work, tooked for me. Imported a bracket and had no idea how to align it. Tough I'd have to figure out each angle and rotate the body, It took me hours just to get close.

after reading this thread, 3 min. Right on guys, keep the knowledge flowing. ^_^

 Sincerely Jason Warsalla

[carolmdieter]

I am trying to align the face of my component with an origin plane. But I am not able to select the plane. 

[Oceanconcepts]

Do you have Select All checked under Selection Filters? Can you select the origin plane outside the Align command? 

[Anonymous]

I am having this exact problem and have been struggling with it for a while. (I come from SolidWorks so good practice to align everything to origins). The origin planes are simply not selectable when inside the Align command. Selection filter/ visibilities all good, and all other planes can be selected. Help and suggestions would be very welcomed!

[laughingcreek]

You would typically want to to model your object around the origin from the start.  not model it somewhere else and move it there.  if your talking components instead of bodies, those should be placed with a joint.

exceptions to every rule of course.  post your .f3d  file for better/more specific suggestions.

[Anonymous]

Hi laughingcreek,
Thanks for your reply –
Yeh, components, I want to align one component to the other by centring both on the XZ origin plane (thus allowing me to vary relative angle around the Y axis).
It feels super basic and I’m sure it must be possible, any idea why I’m being disallowed?

Thanks!

[laughingcreek]

In the pic you posted, you are trying to align a construction plane with an origin plane.  Not sure how that could work.  if you need to move a construction plane then edit the plane feature.

but, yeah.  this sounds supper basic.  attach a sample model and someone can show you.  jointing each component to each other or to the models origin is probably what you need to do.

[etfrench · Accepted solution]

You can use the Align command between a component and an Origin plane:

The Joint command can't create a joint between a component and a plane, but it can create one between the Main Origin and a component. 

There is no reason to move your components to a plane in order for them to be rotated about a common point.  Simply select joint origins at the rotation point.  If the joint origins don't exist, create them using a point on a sketch.