Export design to Corel Draw to a laser engraver.....

[japmaco]

I have a drawing i wanna export so i can import it my Corel draw 12 program to use it with my laser engraver. These are the formats Corel Draw likes to work with. Didnt find any smart way to do this. Bc i dont wanna re-draw it all in for example ai etc. 

Any ideas would be helpful 😃 

[SaeedHamza]

Hi,

Normally if I want to export a drawing to a laser cutter I save it as dwg file, did you try that?

Regards

Saeed

[japmaco]

I dont have DWG as an option in my export. I also couldnt find a plugin for this. Maybe someone can Point my to how this is done ?

[SaeedHamza]

Hi,

Create a new drawing from design, and then choose dwg from export menu

[TrippyLighting]

I am assuming you are talking about a model, not a drawing.

If you want to export a .dxf from a flat object as shown in your screenshot you don't need to create a drawing first.

You can start a sketch and then select the top surface of your object and stop the sketch.

If you have "Autproject geometry on achieve sketch plane" in the preference->design panel then that will have created a sketch with clean projections that you than can export as a .dxf file that can be laser cut.

I've done this many times.

[dstevenslv]

Peter's method is the way to get to cutting the fastest.  I've used it before and it works well.    For assemblies that are mostly cut parts I don't find that workflow efficient.  If it's a few parts or a larger assembly, it's great.  My kits are flat packed cut parts with each assembly having as many as 40 or so parts or as few as 6.  For the large flat cut assemblies I do it the other way, I generate the flat parts in 2D CAD or a drawing program (mostly Corel) to use for design/manufacturing.  I then import a raw dxf into F360 to be used strictly for modeling.  At that point I'm using F360 as a render app and not so much for design.  On the flip side, I can take a printed part from concept to machine quite easily with F360.  

Unless Autodesk changes the CAM and or printing paradigm you won't be able to go straight to your engraver/cutter without using the workaround described above or getting it into some other program (like you are doing with Corel now).  Most lasers, pro or prosumer 36"x24" and under use eps printer drivers to print directly from a program.   I've experienced this with Universal, Epilog, Trotec and the G.Wieke/Full Spectrum I have in my shop.  A potential way to do this in F360 would be to right click the face and choose an option that could be called "send to engraver" or some such.  That in turn would bring up a workspace that's basically a print dialog box to transfer your file to your specific laser cutting.  This is pretty much the same workflow I use to get printed parts from F360 to Simplify 3D to the machines in my farm.

[Anonymous]

The best way to do this in my opinion is to export every sketch as a seperate .dxf which can easily be opened in CorelDraw.

You can do this by just right clicking a sketch in the explorer and saving it as dxf.

There you can save it as a .cdr file to send to your laser cutter/engraver. This is what I do for my laser cutting.

In case you are starting from a drawing, you can directly export as .dxf and use that in coreldraw.

Hope my answer was useful.

[davebYYPCU]

Best way - one sketch one file?

I use DXFer, downloaded from Github.

Select planar faces of all parts to cut, they are saved as dxf in one file.  Sort out in 2d software for cutting.

Might help....

[mgomesAU2KQ]

This was really helpful! First I tried the strategy to make a drawing with the profiles I wanted to cut, but when I imported the dwg file into CorelDraw, there were no lines at all. Then, I used the strategy to create a new sketch, then project all of the geometry that I wanted to cut. Then back in Solid mode, you can select the sketch, right click, and select "Save as DXF." That worked perfectly! Thank you!

 

[Warmingup1953]

In your example, I gather you just want a file that you can import into CorelDraw (and you drive your CO2 Laser direct from CorelDraw?) that represents the "Shape" you want the laser to cut out. .dxf is the way to go. If there is a single sketch that has ALL that you need simply right-click on that sketch in the Tree and Save as .dxf. If not all on a single sketch you can create a new Sketch (named say "for laser")  and then project the geometry...or use a free add-in that does all that for you. 

https://apps.autodesk.com/FUSION/en/Detail/Index?id=7634902334100976871&os=Win64&appLang=en

[hpviet75]

yeah, it's work. thank you so much