Drawings won't update after design changes
I was curious and changed your threads from 4,5 mm (your value) to 3.5 (resulting diameter in model: 2.93) and the other thread from 4.0 mm (your value) to 3.0 (resulting diameter in model: 2.53).
Then I saved the model, updated the drawing and the results are ok, no problems (see screen shots).
You have to be patient with the drawing update and wait until the cloud storage of the model is complete.
I'm beginning to think I must be living in some form of mind altering time warp!
When I download those files (the same ones as you, presumably), without changing anything at all, the hole diameters in the model are both 3.33mm (tapping size for M4), yet the drawing still shows 3.78mm.
I'm wondering where you got these odd hole dimensions from (4.5mm??). The hole dialog shows the M4 definition and when I measure the result, it's what I'd expect. Meanwhile, the drawing stays the same (3.78mm) no matter what I do.
The 4.5mm holes that DO exist are the clearance holes in the mating plates. Could that be what you modified?
I'm tempted to consider marking the holes out and drilling them by hand at this rate. Placing the holes in a sketch seemed the sensible approach and the resulting arrays of holes are hardly complex.
@Muzzerboy wrote:
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....I'm wondering where you got these odd hole dimensions from (4.5mm??). The hole dialog shows the M4 definition and when I measure the result, it's what I'd expect. Meanwhile, the drawing stays the same (3.78mm) no matter what I do.
.....
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To answer your question, this is what I did:
1) downloaded the drawing you published - the file: 4th axis assembly Drawing June.f3z contains the referenced model, that was all I needed
2) uploaded 4th axis assembly Drawing June.f3z into my Fusion 360
3) opened the model
4) selected the thread hole in the component Motor side plate , then mouse right-click to edit feature (see screenshot)
5) then I got the dialog-box with the 4.5 mm (see screenshot)
6) measured the hole diameter => 3.783 ((see screenshot)
I guess you dont´t work in the model that is referenced by the drawing - please see my post #9. The model referenced by the drawing is shown in the data-panel (see last screenshot). Please see what´s shown on your computer.
Well, that's very much been the problem from the beginning. The drawing is STILL stuck at v76 and in the meantime the design is (now) at v87, which is pretty much what I said at the top of the post. All of the revisions in the interim have been me pulling my hair out with this. I have done almost nothing to get the design closer to metal.
You might argue that I don't need the drawings if I simply go to CAM now but I find them helpful for setting up the stock, identifying which piece is which and checking the dimensions before scrapping any of the expensive stock. However, I have a life to live, so that may be the pragmatic route on this occasion.
And given that the drawing file has now become inaccessible ("file failed to download" - that just had to happen), I will just move on and let somebody else figure it out. I don't imagine this is a one-off, as that's not the way software works.
Recreated a one sheet drawing just now, then made a trivial change to the design and it appeared to update (the yellow triangle disappeared), then changed it back. The data panel says it's still at the original version 87 but there is a newer version 89 available. Well yes, I know that - so how do I get it to update??? I've tried the obvious(?) stuff. I can see the v89 on the server. This is doing my cake in.
Something that could be a problem for anyone downloading the 2d drawing as an F3Z file is it will probably still be linked to the old 3d design. I fell into this trap a while ago where I downloaded a 2d drawing that had not been updated so got an older version of the 3d model.
Here's an example of what I mean. The 2d drawing is still linked to V5 so if I download the 2d drawing I'll get V5 of the 3d design not the latest V6.0
@Muzzerboy One thing you could try is clearing the user cache to see if that forces the 2d drawing to update to the latest version. @Phil.E Can you help.
Thanks Mark
Mark Hughes
Owner, Hughes Tooling
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@Muzzerboy wrote:
Recreated a one sheet drawing just now, then made a trivial change to the design and it appeared to update (the yellow triangle disappeared), then changed it back. The data panel says it's still at the original version 87 but there is a newer version 89 available. Well yes, I know that - so how do I get it to update??? I've tried the obvious(?) stuff. I can see the v89 on the server. This is doing my cake in.
The images above are from the online hub? What happens when you open the 2d drawing in Fusion, is there no option to get latest?
Mark
Mark Hughes
Owner, Hughes Tooling
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You have saved v76 of the 3D model as a milestone.
The drawing references this milestone and will not update until you save a new milestone. That is seen in your "Uses" image. The drawing uses v76, the milestone version.
Milestones are the way to add release management (in rudimentary form) to your designs. It also prevents version churn in production.
The help section has much more detail:
http://help.autodesk.com/view/fusion360/ENU/?guid=Fusion_Import_designs_milestones_versions_html
It works like this, an example scenario:
- You are ready to make a prototype of your design. In release world, this is typically Rev1.
- You save Rev1 as a milestone, make drawings of it, and now it can be machined in your shop using your model and drawing.
- Meanwhile your design engineers begin working towards a first commercial release, typically Rev A.
- You make changes to the 3D model, change minor details for whatever reason, start rendering, begin doing more Simulation, making more drawings, animations, etc. (all of which forces saves)
- But the shop is still working with a milestone version Rev1 drawing, undisturbed by all this activity.
In other words, you begin doing the "rev A" work that requires many saved versions and you don't want to disturb the milestone Rev1 which is actively referred to by Fusion users in your machine shop. Until you save a new milestone "Rev A" for example, the drawing will not update. It refers to a milestone at v76.
Regards,
Phil Eichmiller
Software Engineer
Quality Assurance
Autodesk, Inc.