Delete unwanted body after body split

[Anonymous]

I am new to Fusion 360 so this may have already answered. I have created a component with a complex body (not a simple rectangle) that I want to make a 45 degree angle miter cut on the end. I can make the cut using an angle construction plane and the split body command. I can also make the unwanted body disappear using the visibility. However I would like to delete the unwanted "cut off" body. When I try to delete the unwanted body, the component reverts back to the state before the cut. Any suggestions?

[jeff_strater · Accepted solution]

Yeah, this is a confusing one.  The short answer is use "Remove" to get rid of the half of the body you don't want, instead of "Delete".  I'll look for the post where this is explained in more detail, and link to it here.

Jeff

[jeff_strater]

Here is that post:  what-is-the-difference-between-delete-and-remove-a-component-or-body

[Anonymous]

HELLO @Anonymous

Select unwanted side and make it new component > from ASSEMBLE then delete it... it will be deleted easily

[Anonymous]

Yes this work. Thanks to all!

[Anonymous]

OMG, all of this is insane...like I've been working in fusion all day trying to figure out all sort of small things like this that are sooooo counter intuitive, and I've worked in Autocad since forever, but still, this software is something else...sorry, not helpful to anyone just complaining. Solution here works, but I really don't understand why a simple delete like any other program can't work...

[g-andresen]

Hi,

I've been using Fusion for over three years now.
As @jeff_strater  said before, the command "remove" is daily bread and by no means cumbersome.

günther

[Anonymous]

Hi,

If you are working in the Parametric Mode with a Timeline recording your operations, you can only use "Remove" instead of "Delete". You can only "Delete" an object or a curve when it is not referenced or related to other operations in the Parametric Mode.

If you want to use "Delete" you have to go to "Direct Modeling Mode" by clicking the "Toothed Wheel" on the lower corner and select "Do not capture design history" when you are working on a model. See this screen shot. Then you can use "Delete".  You can always go back to Parametric mode after this operation but then you would had lost the previous history recordings.

Hopefully this will help!

Note: You were also right. Depending on your final ultimate goal of your Designs. If you are selling your Designs to Clients with all rights or "Copy Rights" you should convert your f3d files into "Direct Modeling Mode" and delete all the unwanted curves, and objects. A clean file with no history is best so that the clients will not alter the operations on the timeline and claim you for objects not to their expectations. This is to protect yourself. Most of the time we supply STEP files and a cleaned f3d file to our clients. So the simple "Delete" is important. So you were right too!

Kingson

[jeff_strater]

If you are interested in the difference between "Delete" and "Remove", see this thread:  what-is-the-difference-between-delete-and-remove-a-component.  Basically, there are two operations, one (Delete) removes the features that created this object, ("hard delete") and the other (Remove) inserts a timeline entry which gets rid of the object at some point in time, but does not remove any features ("soft delete").  As discussed in that thread, the terminology was a struggle, and may not have arrived at the best terms...

[intelinc]

Thanks @jeff_strater for the clarification on this. I've been using fusion 360 for close to a year, and had no idea Remove existed!

It might be useful to look into the initial discoverability (or lack thereof) of this particular function. Maybe a popup tooltip the first time or two a user deletes a removable body, or even some additional detail accompanying the warning that deletion will have impacts to other elements in the timeline, and that removal might be another option. Or, possibly some visual coupling/nesting in the menu. Whatevs.

This is the kind of non-obvious feature that I clearly overlooked, and then subsequently worked-around by leaving a ton of unused invisible tool bodies in my wake. As a result, I have gone along for the better part of a year thinking components littered with dead bodies was some odd but necessary quirk of Fusion 360 that I must abide, when the solution was literally right below "Delete"! But since "Remove" has no immediate corollary in software I am familiar with, I skipped right over it. In retrospect I fault my own ignorance, but without a sufficient understanding of my misunderstanding, I (and people in general) tend to fault the application, with the accompanying emotional valance that entails. My apologies for quietly hating on F360 for this. 😉