component cut component

[matisok]

Hi

Is there a way of making one component (A) "cut out" in another component (B) and when I move component A the cut follows into component B. 

I using Fusion to in a electronics hardware box design. And as I have many small components (like switches) that I want to move around on eg. the lid of the box I want to be able to output a 2 drawing for the 3D model that I can then make a laser cut from and see if it works. 

Thanks for any help. I enclosed a sample screenshot.

[TrippyLighting]

Yes, break the links to these components. For such a simple design, linked companies are not needed.

Can you share your model ?

[matisok]

Hi

https://a360.co/2OP2bJd

This is the model. I now unlinked the components, but I am not sure how to set the properties of the components and the relation to eachother.

[HughesTooling]

You may want to experiment with Derive\Insert so you don't have to break links to the external designs.

Mark

[lichtzeichenanlage]

Insert Derived is your friend. 

You can find some interesting information, opinions and videos about derived designs in this thread.

[TrippyLighting]

Derived components are great, but for this application would NOT be my recommendation.

Standard, purchased components such as the connector in this design don't usually change so the additional overhead that is created by a derived component seems unnecessary.

[lichtzeichenanlage]

Sure, might be "over engineering". And I agree to the connector itself (pins, diameter etc.), but in this case the mounting plate might differ. But IMHO the biggest argue against your argument is that (by my understanding) A should be the Tool  Bodyand B the Target Body

[TrippyLighting]

I will answer this in the other thread you linked to as it is such a nice collection of posts already!

[HughesTooling]

The Mounting plate could be a derived component so it can be cut and the connector can be remain as a linked design. The tool for a combine can be a linked part, it doesn't need to be derived or have it's link broken to use as a tool.

Mark

[HughesTooling]

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@matisok wrote:

I want to move around on eg. the lid of the box I want to be able to output a 2 drawing for the 3D model that I can then make a laser cut from and see if it works. 

Thanks for any help. I enclosed a sample screenshot.

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A problem you might have here is clearances. You might be better off positioning the switches with joints then use them for reverence geometry in a sketch to cut pockets using an extrude.

Mark

[TrippyLighting]

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@HughesTooling wrote:

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You might be better off positioning the switches with with joints

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Yep.

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@HughesTooling wrote:

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then use them for reverence geometry in a sketch to cut pockets using an extrude.

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Nope 😉

I would edit the original connector component and design another body in it for the sole purpose of cutting openings into the front plate.

That way you can re-use the component in as many locations in the same design on the same front plate or in other designs as you wish and once you know the cutout is correct will always have the correct cutout in any design.

If you need several copies of the same connector (or whatever) in the same design then you don't need to de-sketch and re-design the cutout every time. You just use the extra body in each separate component to make the cutout in the front plate.

[lichtzeichenanlage]

Clearance between the to parts? You can just press/pull the faces in the target body...

[HughesTooling]

I like @TrippyLighting's idea, I demoed a program a while ago that had this idea built in. You'd create a component and it's pocket, when inserted into a design the pocket was automatically cut into the body it was position on.

Mark

[matisok]

Thanks for the help - derive is my new friend.

I need a bit more help though: as I move the tool from the target, I want the cut to follow the tool. See screen cast. In the screen cast the hole stays in the target which is not good.

[TrippyLighting]

There's no screencast

[lichtzeichenanlage]

Yes - that's smart.

[matisok]

Sorry, thought I had selected it (forgot to hit "insert"). Trying again.:

[TrippyLighting]

Yes, of course that does not work. You are moving the component in the timeline after you cut the hole 😉

[lichtzeichenanlage · Accepted solution]

You can either travel back in the timeline and move the part before the Combine feature was created or - and this would be my preferred way - create a joint and adjust it whenever you want. You can do it by offsetting the joint or by using a helper sketch like I did in this screencast:

[lichtzeichenanlage]

You're just to fast for me 😉