A way to create the last Component in a Drawing again without going to Plan?

[Anonymous]

When creating a Drawing in the same sheet I am constantly going back to the reference Plan to do Right click on Component -> Create Drawing -> Drawing pop-up -> Select existing Drawing -> Select existing sheet -> Ok

This is about 5 to 9 clicks for each view of a component I need to put down in a Sheet. Depending on if a new sheet is needed, whether the popup window registers the correct clicks, etc.

If I have to do, say 20 components, each with 3 to 4 views it gets repetitive, error prone, and time intensive, etc.

With a large history chain, Fusion bogs down toggling between Plan and Drawing tabs each time and can take 2+ minutes just to render the Left side Navigation tree each time. (i7 quad core, 16 GB RAM, Nvidia 960, gaming laptop)

Combine the number of clicks with the repetition and the time delay and drawing creation is a major chore that can easily take over 5 hours.

Is there a way to save the last component to some kind of Clipboard and then stay within a Drawing sheet, and just select that component from a list or use a hotkey somehow to just paste / create the most recent component again into a sheet?

Rather than doing all the steps to select a component from the original plan each time for each view?

I'm going to feel really stupid if you tell me I've been adding Components to Drawings the hard / wrong way and there's a much easier / faster way.

Thanks.

[cmiller66]

Hi claybuddy,

Here's what I would do:

1.  From the Model > Create new drawing from Design > Place the default base view (all components) on the sheet

2.  In the (Drawing) browser, Shift+Select all > right-click > Suppress

3.  Toggle ON the one component you want the view of - At this point you can double-click the view and change the scale if you need to.

4.  Now use the Projected View command on the Drawing Views toolbar to project out the Top, Side, etc. views you want (I'm assuming this is what you're in effect doing when you say 20 components, each with 3 to 4 views).

This process can be repeated on additional sheets, now that we have the browser in the drawings you can experiment with the right-click Suppress/Unsuppress options to do this pretty quickly.

Does that do it for you?  If not let me know 

Thanks,
Chris

[Anonymous]

Thank you.

That is sort of what I'm looking for.  It would be great, but choosing "Orientation" is the big road block.

I had tried to use the Main and Projected views before, but they never do what I want them to do.

I like to do a NE iso view first.  Then for example, Top, Left and Front views with dimensions.  Repeat for 20+ components.

First Problem - if I click the Main view button in the upper left it only gives me a Front view.  The dropdown in the popup box that says "Orientation" is always missing.

But if I start from the plan and do Right Click -> Create drawing, then I always get "Orientation" dropdown.  This is why I am always forced to go back to the Plan to do Create Drawing.

Second Problem - let's assume I just start from the plan and get to a NE iso view.  If I do a main NE iso view, it only lets me project NW, SW, SE, etc.  Again, no way to select "Orientation".

This is not much use to me because having different iso views doesn't let me show dimensions - which are very critical to measuring cuts.

If I start from the plan and choose a Front or Left view, then the Project view from that only lets me do other Front or Left views, in different rotations.

Not useful all because if a part is 24 inches wide in the Front view, it's still going to be 24 inches wide if it's rotated 90 degrees.

What I need is a quicker, easier way to say:

"Put a NE iso view here" (1 or 2 clicks - not 6 to 13 clicks and waiting for Left navigation to render")

"Put a Front view here related from the same component as iso view just previous" (1 or 2 clicks - not 6 to 13 clicks and waiting for Left navigation to render")

"Put a Top view here from the Front view just previous" (1 or 2 clicks - not 6 to 13 clicks and waiting for Left navigation to render")

"Put a Left view here from the Top view just previous requested" (1 or 2 clicks - not 6 to 13 clicks and waiting for Left navigation to render")

Alternatively, if there were a way to use the Upper Left Main / Projected view button functions and have "Orientation" dropdown menu enabled - this would probably be the best route.

The more I think about it, it's the lack of not being able to choose Orientation that is really the problem.

Any other secrets maybe in Fusion I don't know about that could help speed the whole Drawing process?

[cmiller66]

Hi claybuddy,

What you describe here: "if I click the Main view button in the upper left it only gives me a Front view.  The dropdown in the popup box that says "Orientation" is always missing." sounds like a bug.  Are you on Mac or Windows?  If you are creating a base view you should always have the orientation control available.  We do have a dialog where you can't change the orientation, that is when you edit (double-click) an existing view:

You're right, if the first view you place on a sheet is an isometric one, you can't project that out to get an ortho front, side, top view.  Can you try this workflow and see if it gets you closer to what you want?

1.  In the design > Right-click your component > New drawing

2.  Place your NE Iso view > OK the dialog.  Browser now appears in the drawing

3.  Right-click the top item in the browser, right under Sheet 1 > Click Base View

4.  Base view preview appears at the cursor with Front orientation as default > the orientation drop-down is in the dialog and you can change this if you want.

5.  Place the base view.  Note: At this point, depending on the size of the part and orientation on the sheet, you can use Rotate to rotate it 90 degrees if that better fits the sheet

6.  Now use the Projected View tool to create your other ortho views

How large/complex is your assembly?  What are your system specs?  If you are waiting for projected views to render I'm wondering if we're hitting some kind of system limitation.

Thanks,
Chris