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Insert Custom View in Drawing

Anonymous

Insert Custom View in Drawing

Anonymous
Not applicable

Hi all,

 

I want to insert view in drawing, but model is 40° rotated to front plane. When i try to insert in drawing as a front view, it is taking oriented view. I need basic front view to be inserted.

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Replies (18)

mishrani
Autodesk
Autodesk
Accepted solution

Hi @Anonymous,

 

You can use NamedView to get the orientation you want -

1. In the design, use "Look At" (available in the bottom navigation bar) then select the face you want to see in your view.  You'll now be looking at that face head on.

 

LookAt.PNG

2. Create a new named view of that orientation (Right-click Named Views in the browser)

 

NameView.png

 

3. Now when you create a drawing and place the base view, select the corresponding named view as the Orientation in the Drawing View dialog.

 

named_view_orientation.png

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Anonymous
Not applicable

Dear Mishrani,

Thanks for your support and quick response..!!!

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HughesTooling
Consultant
Consultant

Just want to add if you can't orientate the view correctly add a joint origin and select when you use Look At.

Here you can see the document origin isn't aligned with the base of the triangular face but adding a joint origin and selecting with look at aligns the part.

tool2.png

 

Mark

Mark Hughes
Owner, Hughes Tooling
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ELAFING
Advocate
Advocate

I needed this tonight. Just want to say thank you.

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Anonymous
Not applicable

I created a "named view" per your instructions. Saved the file. Created a drawing but when I placed a base view the new named view was not on the list!

Help

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HughesTooling
Consultant
Consultant

@Anonymous  Can you make a screencast of what you're doing? I just did a test and it worked correctly for me.

 

Mark

Mark Hughes
Owner, Hughes Tooling
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Anonymous
Not applicable
Good day Mark,



Thank you for replying. The missing step was to hit refresh in the drawing
and then the new view was there.



Regards,



Carl
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Anonymous
Not applicable

Hi all...

 

Reviving an old thread here but I can't post a new one without it being marked as spam... Similar issue as op, need a custom view of an angled part but I can't make it happen when generated from an assembly... Works fine when generating drawing directly from the part. Any help greatly appreciated

 

 

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Anonymous
Not applicable
Save a screen capture as a .jpg, or equal, picture file the insert the
picture in the drawing. No the most elegant solution but when all else fails
this can get the job done.

Carl
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Anonymous
Not applicable

Thanks for the reply. Unfortunately a jpg wont work as I need to import the drawing file into other software and need to pick up the geometry....

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DokteurP
Explorer
Explorer

 .

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markaudacity
Enthusiast
Enthusiast

Necroposting because yours is the only answer I've found to this problem, but this no longer seems to work; Look At will not allow me to select a joint origin, either attached to a sketch object or to an extrusion from it. 😕

[EDIT: apparently you have to select the join origin first, then click Look At.]

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gbeaudryHG2AS
Contributor
Contributor

THANK YOU!!!

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Imprenta3D
Participant
Participant

Thanks, very hepful.

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HughesTooling
Consultant
Consultant

Unfortunately my workaround from post #4 using a joint origin to align Look At no longer works.😠 I think when the gave us the new pretty joint origin they broke this feature.

Below I've selected the joint origin, clicked Look At but the view does not aligned to the joint origin's X and Y.

HughesTooling_0-1634226883848.png

 

Mark Hughes
Owner, Hughes Tooling
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mango.freund
Advisor
Advisor

Unbenannt.PNG

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HughesTooling
Consultant
Consultant

HughesTooling_0-1634228984298.png

 

Mark Hughes
Owner, Hughes Tooling
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jhackney1972
Consultant
Consultant

If I understand your old Joint Origin / Look At command trick, I believe you can now accomplish the same process by placing the Joint Origin on your component and then use the Align command with it and the Origin point in the Browser.  From that you can capture the Named View.

 

John Hackney, Retired
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