HELP ON 3+2 Post Processor

[kmarkopouliotis]

Hi,

i trying to modify Autodesk's Haidenhain Post Processor in order to make 3+2 operations, (specially drilling-tapping-internal thread milling).

In compressed file i have my machines .mtd but programm example but  i'm facing a problem i don' know how to set parameters 'machine B' and 'machine C'

Can anyone give me a hand...

Thank you

[kmarkopouliotis]

Ver2014

[Anonymous]

Thx.

Your attached .cut files Output Workplane always "Front" .

[kmarkopouliotis]

YES FOR THESE .CUT FILES Wpl IS ALWAYS FRONT

[Anonymous]

These .cut files is FiveAxis output. Check in Toolpath Start:

Result:

Modification for  simple 3+2 program:

Output for 40x20 rectangle:

optfile.Multiaxis.WorkplaneDefinition=Machine

140  PLANE AXIAL B-24.2475 C76.389  TURN F1000
141  L  X-3.7008  Y-22.0523  FMAX 
142  M08
143  CYCL DEF 32.0 TOLERANCE
144  CYCL DEF 32.1  T0.1 
145  CYCL DEF 32.2  HSC-MODE:1 TA2
146  L  X19.8623  Y10.2708  Z-1 R0  FQ2 
147  L  X3.7008  Y22.0523  Z-1
148  L  X-19.8623  Y-10.2708  Z-1
149  L  X-3.7008  Y-22.0523  Z-1
150  L  Z-1  FMAX  M91
151  L  X-1100  Y-1  FMAX  M91
152  PLANE RESET TURN F1000
153  M9

optfile.Multiaxis.WorkplaneDefinition=Euler

140  PLANE SPATIAL SPA-20.0  SPB-14.0  SPC-20.0  TURN F1000 SEQ+
141  L  X-20.0  Y-10.0  FMAX 
142  M08
143  CYCL DEF 32.0 TOLERANCE
144  CYCL DEF 32.1  T0.1 
145  CYCL DEF 32.2  HSC-MODE:1 TA2
146  L  X20.0  Z-1 R0  FQ2 
147  L  Y10.0   Z-1
148  L  X-20.0  Z-1
149  L  Y-10.0  Z-1
150  L  Z-1  FMAX  M91
151  L  X-1100  Y-1  FMAX  M91
152  PLANE RESET TURN F1000
153  M9