Press Fit

[skeusemann]

Dear community,

I am having trouble with modelling a press fit. Below you can see a sleeve (yellow) that is applied by a press fit onto the shaft (red). The picture shows a cut through the symmetric model. In Inventor professional I would simply make the sleeve a bit smaller and apply a shrink fit with no sliding contact. As a result I would then see the defomation of the sleeve and the shaft. How can I achieve this with Nastran in-Cad?

I would really appreciate any help.

Kind Regards

Santino Keusemann

P.S.: In case someone wants to model this with actual numbers, the shaft diameter is ø260 mm and the sleeve will be 0,26 mm smaller.

 

[Andrew.Sartorelli]

Hi Santino Keusemann,

Welcome to the Nastran In-CAD forum! Interesting question you have there, I had to do a bit of research myself on this. With a physically modeled interference you will need to use a non-linear static solution. Once you've defined your separation contact between the two surfaces in question we will need to make one change to the the Nastran Parameters, these can be found at the bottom of the model tree. Simply right-click and Edit, go to Non-linear Solution Processor Parameters and check the Advanced Setting checkbox. You will then want to set NCONTACTGEOMITER to 0, this will cause the solver not to move around the contact elements that already have interference detected. With these settings you should be able to observe your interference fit with Nastran In-CAD.

Regards,

Andrew

[skeusemann]

Hi Andrew,

thank you very much. I will try it as soon as possible. This week I will be on business travel. Afterwards I will check it.

Mit freundlichen Grüßen / Best regards

Dr.-Ing. Santino Keusemann

[Andrew.Sartorelli]

Hi Santino,
Safe travels, please let me know if you run into problems upon your return.
Thanks,
Andrew

[50h9j]

Dear Dr.-Ing. Santino Keusemann,

I have tried to model a similar problem. Did you get your model to run successfully?

Robin

[John_Holtz]

Hi Robin,

Are you having a problem with an analysis? If so, I suggest that you create a new post and describe your analysis, such as

• Analysis Type
• details of the problem you are encountering. (warnings or error messages, and so on)
• If you can attach your model, that would be the most help. Otherwise, you would need to provide details about the loads, constraints, contact definitions, and so on.

[50h9j]

I will carry on this thread for the moment since I am doing a similar thing and I tried the solution above with no success.

This is the error I get: FATAL ERROR T2135: UNABLE TO GENERATE SURFACE CONTACT USING SPECIFIED PARAMETERS

[John_Holtz]

In the model from 50h9j, the warning occurs because the solver cannot find any nodes on surface 1 that are "in the plane" of surface 2. By default, it is looking for nodes that are 0 mm apart.

Since the model includes the interference fit of 0.1 mm, the surfaces are initially "separated" by 0.1 mm. You need to enter a "Max Activation Distance" on the surface contact setup that is larger than this distance. A value of 0.2 mm will work. See the attached image.

[skeusemann]

Hi Robin,

in fact there were two possible solutions. One is to apply a temperature field and the other one is to do as described in the answer by Andrew. To be honest, I considered both solutions to be longer than just using the Inventor FE-tool, which I then did, and that gave me the solution I wanted.
I was really in a hurry at that moment, and needed a quick solution, so I didn't really have the opportunity to try the Nastran way.

Mit freundlichen Grüßen / Best regards

Dr.-Ing. Santino Keusemann
______________________________
Gleitlagertechnik Weißbacher GmbH
Weseler Str. 32
D-46519 Alpen
Fon: +49 (0) 2802 1025 - 24
Fax: +49 (0) 2802 7435
E-Mail: skeusemann@gtwalpen.de
Internet: www.gtwalpen.de



Geschäftsführer:
Dipl.-Ing. Georg Weißbacher
Dipl.-Ing. Ferdinand Pötters
Dr.-Ing. Christoph Weißbacher
Amtsgericht Kleve: HRB 6710

Wie Sie wissen, können über das Internet versandte E-Mails unter fremdem Namen erstellt oder der Inhalt verändert werden. Aus diesem Grund sind unsere als E-Mail verschickten Nachrichten grundsätzlich keine rechtsverbindlichen Erklärungen. Der Inhalt dieser E-Mail samt Anlagen ist vertraulich und u. U. rechtlich geschützt. Der Inhalt ist ausschließlich an einen bestimmten Empfänger gerichtet. Eine Weitergabe, die Herstellung von Kopien oder der sonstige Gebrauch durch Nichtadressaten ist nicht erlaubt. Ich bitte daher jeden anderen Empfänger, der diese E-Mail versehentlich erhält, mich umgehend zu informieren und die Nachricht zu löschen

As you are aware, messages sent by e-mail can be manipulated by third parties. For this reason our e-mail messages are generally not legally binding. This electronic message (including any attachments) contains confidential information and may be privileged or otherwise protected from disclosure. The information is intended to be for the use of the intended addressee only. Please be aware that any disclosure, copy, distribution or use of the contents of this message is prohibited. If you have received this e-mail in error please notify me immediately by reply e-mail and delete this message and any attachments from your system. Thank you for your cooperation.

[skeusemann]

Hi Robin,

in fact there were two possible solutions. One is to apply a temperature field and the other one is to do as described in the answer by Andrew. To be honest, I considered both solutions to be longer than just using the Inventor FE-tool, which I then did, and that gave me the solution I wanted.
I was really in a hurry at that moment, and needed a quick solution, so I didn't really have the opportunity to try the Nastran way.

Mit freundlichen Grüßen / Best regards

Dr.-Ing. Santino Keusemann
______________________________
Gleitlagertechnik Weißbacher GmbH
Weseler Str. 32
D-46519 Alpen
Fon: +49 (0) 2802 1025 - 24
Fax: +49 (0) 2802 7435
E-Mail: skeusemann@gtwalpen.de
Internet: www.gtwalpen.de



Geschäftsführer:
Dipl.-Ing. Georg Weißbacher
Dipl.-Ing. Ferdinand Pötters
Dr.-Ing. Christoph Weißbacher
Amtsgericht Kleve: HRB 6710

Wie Sie wissen, können über das Internet versandte E-Mails unter fremdem Namen erstellt oder der Inhalt verändert werden. Aus diesem Grund sind unsere als E-Mail verschickten Nachrichten grundsätzlich keine rechtsverbindlichen Erklärungen. Der Inhalt dieser E-Mail samt Anlagen ist vertraulich und u. U. rechtlich geschützt. Der Inhalt ist ausschließlich an einen bestimmten Empfänger gerichtet. Eine Weitergabe, die Herstellung von Kopien oder der sonstige Gebrauch durch Nichtadressaten ist nicht erlaubt. Ich bitte daher jeden anderen Empfänger, der diese E-Mail versehentlich erhält, mich umgehend zu informieren und die Nachricht zu löschen

As you are aware, messages sent by e-mail can be manipulated by third parties. For this reason our e-mail messages are generally not legally binding. This electronic message (including any attachments) contains confidential information and may be privileged or otherwise protected from disclosure. The information is intended to be for the use of the intended addressee only. Please be aware that any disclosure, copy, distribution or use of the contents of this message is prohibited. If you have received this e-mail in error please notify me immediately by reply e-mail and delete this message and any attachments from your system. Thank you for your cooperation.

[50h9j]

John, thanks for that simple but critical solution.

Robin

[50h9j]

John,

I have done another very similar simulation but this fails with an E5000 error.

Would you mind taking a look?

thanks

Robin

[50h9j]

Is it because the pulley is not restrained from lateral movement? What would be a good way of modelling a grub screw?

[John_Holtz]

Hi @50h9j

Strange. I ran your model (RotorStar 4962-500kv motor.zip) but did not get any errors. There was one part missing from the assembly (RotorStar 4962-500kv.ipt), so that may have been the problem if that part was included in your analysis.

In general, I would agree that having parts in a static analysis that are not statically stable can be a problem. For this particular model (a pulley on a shaft), I would not get too fancy with trying to model the connection between the grub screw (set screw), pulley , and shaft. Instead, I would apply a constraint at the bottom of the screw hole to hold the pulley in the axial direction (Z direction in  your model).

If you were doing an analysis with an axial load on the pulley and therefore needed the effect of the screw to hold the shaft, I would probably use a Connector > Bolt to model it. In that case, you would want to make some modifications to the CAD model by splitting surfaces in the region of the screw.

[50h9j]

There are only 2 parts in the analysis. I think the missing part derives the shaft.

I have put a constraint on the bottom edge of the hole in the z-direction as suggested.

I also found that the interference contact was asymmetric so I changed that.

It now solves in 10 increments. The internal surface of the plastic pulley is pock-marked while the steel shaft is smooth. I realise this is highly magnified but it seems to indicate a poor quality solution. It does not give me much confidence that applying a torque to the pulley as well will give accurate results.

I wondered about modelling a segment but was not sure how torsional deflections would be handled. I suppose I could slice it using x-y axis planes and ignore edge effects.

[50h9j]

There shouldn't be this asymmetry in a press fit?!

[50h9j]

I tried a 2mm slice then I tried mid-planes using a 0.1mm slice. Finally got it to solve for bonded and separation contact as a linear static analysis.

Not sure why separation result gives an overlap. Still won't solve as a non-linear static analysis.

Neither have an interference fit. I couldn't get that to work with the mid-plane idealization.

separation contact 1:1 scale displacement