Taking the roughest measurements in a view with C#

[nebi_guler]

I want to make the drawing in 

ViewOrientationTypeEnum.kLeftViewOrientation

view as on the left, but it is almost impossible to scale correctly through the Curves in

DrawingCurves[(object)viewDimensions.ReferencedFile.Referenced Document as DrawingCurvesEnumerator]

Can you help me with this? My goal is to get certain measurements.

[Michael.Navara]

If the model is aligned to it's global coordinate system, you can use RangeBox from referenced model.

In this case you can create helper sketch in DrawingView, draw a line in them and create dimensions of this line.

Sub Main()
    Dim drawingView As DrawingView = ThisApplication.CommandManager.Pick(SelectionFilterEnum.kDrawingViewFilter, "Pick drawing view")
    Dim part As PartDocument = drawingView.ReferencedDocumentDescriptor.ReferencedDocument
    Dim rangeBox As Box = part.ComponentDefinition.SurfaceBodies(1).RangeBox

    Dim minPointInSheetSpace As Point2d = drawingView.ModelToSheetSpace(rangeBox.MinPoint)
    Dim maxPointInSheetSpace As Point2d = drawingView.ModelToSheetSpace(rangeBox.MaxPoint)

    Dim drawingViewSketch As DrawingSketch = drawingView.Sketches.Add()

    Dim minPointInSketchSpace As Point2d = drawingViewSketch.SheetToSketchSpace(minPointInSheetSpace)
    Dim maxPointInSketchSpace As Point2d = drawingViewSketch.SheetToSketchSpace(maxPointInSheetSpace)

    drawingViewSketch.Edit()

    Dim diagonalLine as SketchLine = drawingViewSketch.SketchLines.AddByTwoPoints(minPointInSketchSpace, maxPointInSketchSpace)
    diagonalLine.SketchOnly = True

    drawingViewSketch.ExitEdit()

    Dim sheet As Sheet = drawingView.Parent

    Dim diagonalLineIntent = sheet.CreateGeometryIntent(diagonalLine)

    Dim textPoint1 As Point2d = ThisApplication.TransientGeometry.CreatePoint2d(drawingView.Position.X, drawingView.Position.Y - drawingView.Height / 2 - 1)
    Dim textPoint2 As Point2d = ThisApplication.TransientGeometry.CreatePoint2d(drawingView.Position.X + drawingView.Width / 2 + 1, drawingView.Position.Y)

    sheet.DrawingDimensions.GeneralDimensions.AddLinear(textPoint1, diagonalLineIntent, DimensionType := DimensionTypeEnum.kHorizontalDimensionType)
    sheet.DrawingDimensions.GeneralDimensions.AddLinear(textPoint2, diagonalLineIntent, DimensionType := DimensionTypeEnum.kVerticalDimensionType)
End Sub

[nebi_guler]

I will try . And I will get back to you about it. Thank you . @Michael.Navara 

[nebi_guler]

part.ComponentDefinition.SurfaceBodies[1].RangeBox

this line comes empty.  I want to tell exactly @Michael.Navara 

[Michael.Navara]

Sorry I don't understand what happens. Can you upload a test model?

[nebi_guler]

Of course @Michael.Navara 

[Michael.Navara]

I want the Inventor part model, but the screenshot explains a lot.

When you change type of variable part to AssemblyDocument, you need to update rest of your code to work with assemblies and its occurrences and so on.

[abdullah_elq]

FYI @nebi_guler, at my last company we used DraftAid. Their add-in is really good at making these types of drawings.

[nebi_guler]

I dont understand what do you mean " you need to update rest of your code to work with assemblies and its occurrences and so on." I have already written the code you wrote to me.

[Michael.Navara]

Not exactly. Compare line 3 in my code and line 1027 in your. I declare variable part as PartDocument you declare variable part as AssemblyDocument.

I expect you want to create drawing from part not from assembly.

[nebi_guler]

I will replace it and test it immediately

[nebi_guler]

[yan.gauthier]

Hi, 

Here's my code I use to get the bounding volume from a Part. The BoundingVolume is a simple custom class that contains the X,Y,Z dimensions with the Volume.

       public static BoundingVolume GetOrientedRangingBox(PartDocument partDocument)
       {
           //assume partDocument exists

           var bodies = partDocument.ComponentDefinition.SurfaceBodies.Cast<SurfaceBody>();

           TransientBRep transientBRep = AddInServer.InvApp.TransientBRep;
           SurfaceBody? combinedBodies = null;
           if (bodies != null && bodies.FirstOrDefault() is SurfaceBody baseBody)
           {
               combinedBodies = transientBRep.Copy(baseBody);

               if (bodies.Count() > 1)
               {
                   foreach (SurfaceBody body in bodies.Skip(1))
                   {
                       if (body.IsSolid)
                       {
                           transientBRep.DoBoolean(combinedBodies, body, BooleanTypeEnum.kBooleanTypeUnion);
                       }
                   }
               }
           }
           
           if (combinedBodies is null) return new BoundingVolume(0, 0, 0);

           var orientedBox = combinedBodies.OrientedMinimumRangeBox;

           //Autodesk internal dimensions are always centimeter
           double[] dimensions = new double[] {orientedBox.DirectionOne.Length * 10, orientedBox.DirectionTwo.Length * 10, orientedBox.DirectionThree.Length * 10}.OrderByDescending(x => x).ToArray();

           return new BoundingVolume(dimensions[0], dimensions[1], dimensions[2]);

       }

 This method cares not for your part to be aligned with the axis system. 

[nebi_guler]

Thank you i will try and check.