Drawing Sheet Numbering to start from 0
Hi @ben_saundersHDKKB. I do not believe that would be possible. We can rename the sheets, and reorder the sheets however we want, but the little ":1" after the sheet's name is automatic by Inventor, and we do not appear to have any control over that behavior. Those numbers will always remain in the same order they are seen in the model browser tree, even if you move the sheets around, the numbers will correct themselves in that order. It is fairly easy to isolate the main part of the sheet name from that number by code through, if needed. And it is fairly easy to rename the sheets by code, but renaming them generally will not remove or change the numbering system.
Wesley Crihfield
(Not an Autodesk Employee)
I think the closet you can get is to edit the GA sheet and set it to "Exclude from count"
This will result in GA, with no number, and the next Sheet starting at :1, as shown below.
I hope this helps.
Best of luck to you in all of your Inventor pursuits,
Curtis
http://inventortrenches.blogspot.com
Good catch Curtis. I forgot about that simple step since I almost never use it.
Also, just to add a note about that same functionality...it can be accessed/controlled by code too.
Wesley Crihfield
(Not an Autodesk Employee)
Hi @ben_saundersHDKKB. You mean that you want to put a zero where there is nothing showing for the sheet number within that TextBox in your TitleBlock, on a sheet that is 'not included in the sheet count' right? That may be possible, but may also break that 'linked' sheet number functionality represented by the <Sheet Number> FormattedText within that TextBox. It can be pretty complicated digging into the FormattedText of drawing annotations, because of the XML tags used within them. It may be simpler to just create an alternate TitleBlockDefinition, in which that <Sheet Number> portion of that one TextBox is not included, and maybe a static zero ("0") is included instead, just for these occasions. If your TitleBlock does not include any 'PromptedEntries' then it would be as simple as replacing one TitleBlock with another to achieve this goal.
Wesley Crihfield
(Not an Autodesk Employee)
Hi @ben_saundersHDKKB. As a quick test, I created a simple new GeneralNote in one of my drawings, then injected a link to the drawing's Part Number, " - ", a link to the drawing's Stock Number, " - ", and a link to the Sheet Number, similar to how the TextBox in your TitleBlockDefinition is set-up. Then I wrote a small iLogic rule which allowed me to 'Pick' that GeneralNote, and replace the <Sheet Number> portion of its FormattedText, with a "0" (zero). It worked just fine.
Dim oObj = ThisApplication.CommandManager.Pick(SelectionFilterEnum.kDrawingNoteFilter, "Pick a GeneralNote.")
If oObj Is Nothing OrElse (TypeOf oObj Is Inventor.GeneralNote = False) Then Return
Dim oGN As Inventor.GeneralNote = oObj
'Logger.Info("Text = " & oGN.Text & vbCrLf & "FormattedText = " & oGN.FormattedText)
Dim sTextToFind As String = "<DerivedProperty DerivedID='29704'>Sheet Number</DerivedProperty>"
If oGN.FormattedText.Contains(sTextToFind) Then
Logger.Info("Contains the text we are looking for = True")
oGN.FormattedText = oGN.FormattedText.Replace(sTextToFind, "0")
Else
Logger.Info("Contains the text we are looking for = False")
End If
However, keep in mind that in your case, you would be editing the 'definition' of your TitleBlock, which may effect the TitleBlocks on the other sheets, whose TitleBlocks may be based on the same TitleBlockDefinition. That is why I suggest at least having a copy of your original TitleBlockDefinition available, incase editing the contents of the TextBox changes the definition, or maybe just creating an alternate TitleBlockDefinition the way you want it for those types of sheets.
Wesley Crihfield
(Not an Autodesk Employee)
