Project Geometry Between Sketches of Different Parts in Assembly

[Anonymous]

Hi, I have a bit of a problem here

I'm trying to project a geometry from sketch to sketch between 2 different part in an assembly

the object I projected is always non-associative so when I make change in the first part the change don't follow to the second part

how can I make the project geometry associative?

it work if I project a work feature like a workplane form part one in the sketch of part 2 but why it don't work for sketch geometry?

kelly.young has edited your subject line for clarity: Projetc Geometry between sketch of different part in assembly

[jhackney1972]

I am guessing that you do not have the marked "Application Option" "Assembly" tab option checked.  See Attached image

[Anonymous]

hi , it is checked, both of them

[jhackney1972]

Can you Pack and Go and then zip the assembly for others to look at?  If it is too large, create a new assembly and place two parts in it then try and replicate the issue.  If you can replicate it in the smaller assembly, pack and go that one and post it.  Otherwise it will be very difficult to "guess" your solution.

[dgreatice]

Hi,

did you say project geometry from sketch geometry? i think it cant be associative.

associative at cross part geometry projection are model of part like edge, face, etc, but not a sketch geometry.

if you project geometry from sketch, in sketch maybe had constraints fix.

[Anonymous]

ok so you have 2 part in the assembly

the one call"LAYOUT STRUCTURE" is a layout of the axes on a building

if you check the sketch "sketch-plan" I put some sketch block for the hss

i'm trying to project the center line of those into the sketch call Sketch-LAYOUT-FAB-PLAN" so I cant line some of the block ther with it

as you see in the sketch the center line of the hss is in pink not yellow like associative projected line

[dgreatice]

I'm sorry i cant open you file, i'm using inventor 2014.

Like I said before, you cant get assosiative project geometry from sketch geometry. 

if you want to still refer from sketch, you must help that geometry with work feature, like plane, axes or point.

then you can use that feature to get geometry cross another part

[Anonymous]

I tried projecting a workplane and its just put the line all locked up and when I remove the lock its just a line not even link to the other part

[dgreatice]

Oh, sorry im forgot to tell you, im using derived component first to get work feature.

dont direct project geometry at assembly editing.

place end of part at 2nd Part, derive component to first part, get only work feature first part. then set end of part back to the end.

[Anonymous]

and you can project geometry from one sketch to another sketch in another part in an assembly

I just created 2 part, put them in an assembly, projected geometry from sketch one in part one to sketch 1 in part 2 and it work

[Anonymous]

I resolved the problem

the part I was trying to project geometry in was set to adaptive in another assembly, which I did by mistake

so once the adaptivity was remove in the other assembly, everything work just fine

[kelly.young · Accepted solution]

Hello @Anonymous I think a great workflow you could use for sharing sketches between parts would be using Derive.

The sketch will be brought in and anything you do to change the original sketch will update in the part that references it.

You can do this with solids as you bring them in as surfaces (the orange curvy glyph at top right Derive Style).

Please select the Accept as Solution button if a post solves your issue or answers your question.

[Anonymous]

can you derive a sketch into an existing part?

more like share a sketch?

because the part I need the reference into is an existing part

[Anonymous]

it work I just tested it

thanks Kelly

[kelly.young]

@Anonymous in my opinion forget you ever saw adaptive parts unless in the R&D phase where it's absolutely awesome and you can just go crazy. For stable modeling derive is your new best friend.

[johnsonshiue]

Hi! The behavior does not sound right to me. Unless the edge belongs to an assembly feature, projecting an edge from part1 to part2 (with the two options checked) should always lead to adaptive sketch. Could you share the files here?

Many thanks!