ProE to Inventor Translations

[Anonymous]

When I open a Pro E .prt file in Inventor containing any "Family table parts" I get the wrong variant.  I'm told that it generates this type of part on demand, so when I open it, all I get is a generic version.  Is there a way to tell Pro to generate a seperate part for each table member?

[Anonymous]

All translators function in pretty much the same manner - producing "dumb" solid bodfies of the current translated version.

You will have to re-model the part from scratch to produce a table driven component. There is no other way.

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@Anonymous wrote:

When I open a Pro E .prt file in Inventor containing any "Family table parts" I get the wrong variant.  I'm told that it generates this type of part on demand, so when I open it, all I get is a generic version.  Is there a way to tell Pro to generate a seperate part for each table member?

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[RogerMollon]

Kevin,

Please look in the Help for Pro/E import.  I don't know the details myself, but I know we support "Family Table Parts".  It requires writing out more than just the ".prt" file from Pro/E and the Help for Pro/E import describes it.

I hope this helps,

[Anonymous]

Roger,

Can you help me find that information?

A search in the Wiki for 2012 does not find any information for "Pro/E" or "Pro/E Import"

The only area I found that mentions importing from Pro/E is this:

http://wikihelp.autodesk.com/Inventor/enu/2012/Help/0073-Autodesk73/0684-Collabor684/0692-Translat69...

However, In Pro/E, you would have to generate each tabled part, then in Inventor or other solds packages, import as "dumb" solids.

[RogerMollon]

This note was in the built in Help, apparently not carried over to Wikihelp.

Note: To import part or assembly files that contain family table instances, load your model into Pro/ENGINEER and save the accelerator files (.xpr or .xas) along with the Pro/ENGINEER part or assembly files. The accelerator files contain the specific instances referred to by the family table.

I had to do a little digging to find a description how to do this in Pro/E:

1. Open the Pro/ENGINEER file in Pro/ENGINEER Wildfire.

2. File -> Instance Operations -> Accelerator Options

3. A dialog pops up

4. Choose Always, and hit Purge button. Close the Dialog.

5. Save the assembly again—there will be some .xpr/.xas files generated.

Open the assembly in Inventor—Then we can read the instances into Inventor.

This will get the instances translated correctly.  However I assume to original question was about brining over the family table which would take an iPart/iAssembly capability would be a good wish list item. 

I hope this helps,