parallel spline / involute spline connection generator, retrieve model annotations

[jaimin.ja.3]

I have design Shaft and use parallel spline connection generator for the splines

Now in the drafting i want to retrieve model annotations of the spline data is that possible ?

[johnsonshiue · Accepted solution]

Hi! The quick answer is no. The data is stored in the shaft in a format, not understood by the drawing, only accessible by the Shaft Generator. You will need to get the data from the generator and paste it to an Excel spreadsheet. Create a general table from the spreadsheet or insert it directly to the drawing.

Many thanks!

[Alexander_Chernikov]

As we found out (with @Andrii_Humeniuk  , see https://forums.autodesk.com/t5/product-design-manufacturing/inventor-osoblivosti-oformlennya-kreslen... ), information about Spline Connections is stored in the assembly in the "Occurrences" branch: oAssDoc.ComponentDefinition.Occurrences(i).AttributeSets(1).Item(2).Value

It can be obtained using iLogic/VBA, taking into account that the “Value” parameter stores a link to the standard code and to the standard data table in

C:\Users\Public\Documents\Autodesk\Inventor 202X\Design Data\Design Accelerator\Tables\Splines*\namestd.xml

namely in "SplineType" - Standard Code in the form, for example, for ISO 14

<Table InternalName="605A0796-2412-4aa9-81E0-E36325D0AE4F">, and in “Spline” – the line number in the list of possible spline parameters of this standard.

Then you can either rename this element in the assembly or part and/or add a user parameter, which you can then use to call out symbols both in the model and in the drawing.

Of course, the best option would be to create a tool like "Hole and Thread" for the drawing environment that allows you to automatically apply the designation.

[Alexander_Chernikov]

I think, the problem is solved.

See:

https://forums.autodesk.com/t5/inventor-forum/symbols-for-designating-straight-and-involute-splines/...