Fusion
Hi,
The problem has nothing to do with the application but lies in the miserable quality of sketch 31.
As you can see on the screenshot, there are 9 control points in a range of 0.02 mm.
This must inevitably lead to problems with extrusions.
In the future, create sketches in Fusion instead of importing them.
günther
@Silv3rDragon wrote:I have even noticed performance changes in files as simple as the one I am now attaching here.
Use the most computationally efficient modeling techniques.
Symmetry constraints are relatively computationally expensive and often not needed.
You are using very very computationally expensive modeling techniques.
This should be a simple 2D sketches - not a 3D sketch.
Dimensions that cannot be measured in the real world?
Move is almost always the wrong move (pun intended) as used by beginners.
Fish scale sketch is extremelyyyyyyy expensive - Pattern Features - not sketch elements.
Biggest mistake so far in the file.
Many other expensive sketches
Another very computationally expensive sketch - do not use sketch patterns (except in rare cases and very simple).
Unresolved issues highlighted in the Timeline.
More sketch patterns that should be simple sketches with feature patterns.
and more...
Why create simple lines and arcs with hundreds (thousands?) of short little lines.
I recommend that you start over.
Attach your new work here after each and every sketch/feature for guidance by the experts on most computationally efficient technique.
Blue lines and white dots should keep you awake at night.
Ask questions early and ask questions often...
Use the most computationally efficient modeling techniques.Symmetry constraints are relatively computationally expensive and often not needed.
How did you get the dimensions to stay when removing the other half? I've been using mirror to quickly get the full drawing in 2D and then be able to use diameters in dimensioning. I know I can just add /2 and dimension the radius but when we make a lot of the same thing and constantly change dimensions, its easier to use the same number on the drawing and see that it matches at a quick glance.
You are using very very computationally expensive modeling techniques..... and rest of post
Ya, I made all that when I first started using Fusion 360 2.5 years ago and have simplified stuff a lot since then. I am almost entirely self taught through trial and error(learned about dimensions from a co-worker) so I expect poor performance from my old files but not the stability changes.
Dimensions that cannot be measured in the real world?
I have no idea why the numbers are different for you here. I input all fractional inches to the nearest 1/16.
edit: never mind, those are metric numbers for metric threads.
