insert component not working properly

[Anonymous]

I'm having several problems with components I insert into a design. When I recall a design, some parts of the inserted components are "skewed".

The first picture is the component I want to insert into my design. But when I insert into the design it looks like the second picture. Note that often when I insert a design it looks ok, but only after saving and recalling these errors occur.

How can I insert components into the design without this happening? This gets even worse further up the chain in the design when I paste the component of the second picture into a higher level.

Now when I initially did this design, I did not see any of these artifacts and only after opening again this happened. I have updated the software in the meantime. Perhaps the updated software has a problem? I am using version 2.0.9512 running in Windows 10.

[TrippyLighting]

Can you share such a design ? (export as .f3d/.f3z and attach to post).

In the majority of cases, the components are not properly assembled in the source design!

[Anonymous]

Here are the design files for the component and the top level design.

[TrippyLighting]

You need to use the assembly joints to assemble the components within their subassemblies a then also the subassemblies into the main assembly.

You used no joints at all so it isn't a surprise that stuff is out of place 😉

[Anonymous]

OK, so how do I do this? Not something I have ever seen addressed before. Seems that if I insert a component into a design hierarchy, it should represent the component, simple as that.

[TrippyLighting]

This comes up quite often and I address it quite often 😉

The linked component is represented as a component, but it isn't static and once inserted all sub-components from that linked component can be moved around either by dragging them, or using the move tool.

One area Fusion 360 is different compared with many other CAD systems that Components by default are "floating". That allows you to assemble inked components just like any other component. That can be a great advantage!

However, that also comes with additional required actions if you do want that subassembly to be static. 

For example in your HeatSinkBricks5 v1_DoubleCaps v6 subassembly you created and imported components, then moved them into place and used the position capture feature

That is not a recommended workflow. In this case, after inserting the first component into the design I would not move it, but create a rigid group between it and the top-level origin (rigid group joints lock origins together. Which works even on components without any geometry). 

Then I would insert eh next component and create a rigid joint between the new and the existing component, or perhaps the top-level origin.

Then continue the same way with any other componets.

The key to successfully Fusion 360 assemblies is to capture/manage all of the component origins.