Fusion
Community
Are the holes equally spaced around the part?
As it sits, the Fanuc w/Sub Program Post Processor isn't going to give you everything you need. There will be some work on your end. For instance, it's not posting out code in an incremental fashion, but rather, absolute. So, it will return to that exact XY position each time. If we make the center of the hole as X0 Y0, we can then create a macro that increments the XY value of your work offset each time.
I did something very similar not too long ago with a job in my shop. I had a 14 hour cycle time of a part with very repetitive features. Upon recognizing that there was an even spacing among every feature, I programmed up one of the features, stuck it into a sub program and away I went
Seth Madore
Customer Advocacy Manager - Manufacturing
Couple of easy options:
1) Can your control hold two columns or rows of holes? After that, it's a matter of a macro to increment the offsets. Here's what I came up with for my program, I wasn't too inclined to be absent for long periods, thus the M0 between feature patterns:
M0 #601=0 #5241=#5221(STORES G54 IN G55) N1 G65P4103(CALL PROFILE MILLING SUB PROGRAM) M0 #601=[#601+1] #5221=[#5221+1.080] IF[#601LE8]GOTO1 M0(MILLING SHOULD BE DONE) #5221=#5241(RESETS G54 BACK TO ORIGINAL VALUE) M0(VERIFY THAT G54 AND G55 ARE EQUAL) #601=0 N2 G65P4104(CALL DEBURRING SUB PROGRAM) M0(BLOW OFF PART) #601=[#601+1] #5221=[#5221+1.080] IF[#601LE9]GOTO2 M0(ONE SECTION DEBURRED?) #5221=#5241(RESETS G54 BACK TO ORIGINAL VALUE) M0(VERIFY THAT G54 AND G55 ARE EQUAL) #601=0 G0G53Z0M19 G53X13.5 G53Y0 M30
Seth Madore
Customer Advocacy Manager - Manufacturing
Forums Links
Can't find what you're looking for? Ask the community or share your knowledge.
Post to forums
