Community
Fusion Manufacture
Talk shop with the Fusion (formerly Fusion 360) Manufacture Community. Share tool strategies, tips, get advice and solve problems together with the best minds in the industry.
cancel
Showing results for 
Show  only  | Search instead for 
Did you mean: 

I would like to add G90 in front of G54.

6 REPLIES 6
SOLVED
Reply
Message 1 of 7
j.hong3MP6V
181 Views, 6 Replies

I would like to add G90 in front of G54.

Hello.

In my post, only g54 is output, so it moves to strange coordinates.

I want to add g90 like in the picture. Help me.

I am sorry that I am not good at English.2.png

 

6 REPLIES 6
Message 2 of 7
seth.madore
in reply to: j.hong3MP6V

What post processor are you using, and what is your machine/control?

In your original code, 5 lines up, you have a G90. I'm not seeing anything in between those lines that would put it back into incremental (G91) mode.

Have you manually inserted the G90 and confirm that behavior is now proper?


Seth Madore
Customer Advocacy Manager - Manufacturing
Message 3 of 7
j.hong3MP6V
in reply to: seth.madore

OKK VM5

FANUC180is-mb

POST FANUC 

Message 4 of 7
seth.madore
in reply to: j.hong3MP6V

And you've in fact confirmed that the G90 is required in two places?
Since you're using a Fanuc based machine, do you also has a macro for the tool change (it's typically O9001)? I'm wondering if it's leaving the machine stuck in G91


Seth Madore
Customer Advocacy Manager - Manufacturing
Message 5 of 7
j.hong3MP6V
in reply to: seth.madore

The tool change macro is being used like this.

 

O9020;

;

(M6-SUB)

G91 G28 Z0;

M6;

T#20;

M99;

%

 

Message 6 of 7
seth.madore
in reply to: j.hong3MP6V

So, we "could" edit the post to force out a G90, or you could (more properly) append a G90 into your macro, right after the T#20;

So:

M6;

T#20;

G90;

M99;


Seth Madore
Customer Advocacy Manager - Manufacturing
Message 7 of 7
j.hong3MP6V
in reply to: seth.madore

Thank you! Thanks to you, I was able to solve it.

Can't find what you're looking for? Ask the community or share your knowledge.

Post to forums  

Autodesk Design & Make Report