Hi,
I have an older control with limited memory. And I am trying a high feed mill for the first time. My Y travel is used to the max so i cant do straight moves so I need to find a way to have the z height called and the x and y moves be a subprogram. How do i do this?
How "Limited" is your memory on the controller?
And what post processor are you using?
So here's what I recommend:
Create a toolpath at a single Z level (your starting height Z level). Place that toolpath into a Linear Pattern, with the direction being your Z axis and your increment value being your depth of cut. Specify the number of repeats.
Using a post processor that spits out Sub program files, set it to "Patterns".
The result looks something like this:
To answer your question, I have an okuma post I modified. I did watched your video and tried it out. It looks like it is not retracting the model top on the subsequence moves and is going to hit the part on some of the moves. To fix that I separated out those to see if it would lift up but it did not. I cant make it do long paths to avoid hitting the side of the parts because it is at the limit of the y travel. However it did significantly reduce the program size.
Yes. Use a Manual NC command with a Passthrough snippet of code "G0G90Z.5"
The result will be this for the main code:
(FACE SIDES)
G00X0.23Y9.025
Z1.23
M98 P1002
G0G90Z.5
(FACE SIDES)
G00X0.23Y9.025
Z1.19
M98 P1002
G0G90Z.5
And the subroutine will still be the same as it was prior.
