Postprocessor EDING CNC/USBCNC and A rotational axis

[Anonymous]

Dear all

I just installed recently a rotational axis on my CNC machine

and designed a test piece (simple zylinder with some holes) with Fusion 360 and

did the CAM toolpaths with no problems.

Now it seems the usual used postprocessor EDING CNC does not post process my toolpaths.

Do I need another EDING postprocessor or I just need to re_programme the current one?
Any help and advice is very appreciated! (see also error message as attachement)

Cheers

Franz

[ferranti_boy]

hello

for eding to work with a 4th axis you need to put in some extra line's and changes in the post

first you must search for "Function OnOpen() {" and write some extra code

function onOpen() {
// mijn verandering a-as toegevoegd
 if (true) {
    var aAxis = createAxis({coordinate:0, table:true, axis:[-1, 0, 0], cyclic:true, preference:1});
    machineConfiguration = new MachineConfiguration(aAxis);

    setMachineConfiguration(machineConfiguration);
    optimizeMachineAngles2(1); // map tip mode

then you must search for "var tcp = true" and change true with false

// mijn verandering
// var tcp van true op false gezet
  var tcp = false;

this is my setup

i have this from hsm forum

https://forums.autodesk.com/t5/hsm-post-processor-forum/how-to-set-up-a-4-5-axis-machine-configurati...

regards

[Anonymous]

Thanks for the advice, I tried and just works fine now!Best regards

[egal55_1]

there are some Mistakes in this post, to use it correctly with Eding CNC 4. Axis,

needed to correct it for my Router, the first was there was a } missing, so the code crashed the file,

also i needed to correct the axis:[-1,0,0] to axis:[1,0,0] Eding CNC wanted to start machining mirrored,

Corrected Version for my Router and maybe some other ppl. 

Thx Ferranti, your code helped me alot 

function onOpen() {
// mijn verandering a-as toegevoegd
 if (true) {
    var aAxis = createAxis({coordinate:0, table:true, axis:[1, 0, 0], cyclic:true, preference:1});
    machineConfiguration = new MachineConfiguration(aAxis);

    setMachineConfiguration(machineConfiguration);
    optimizeMachineAngles2(1); // map tip mode
           }

[Anonymous]

@Anonymous , where did you find the post-processor for EDING CNCUSB? I'm using the version 4.00 and did not find it. Could I have it with you? Thanks