Mill/turn C axis post - help

[steveKPRTN]

This is from post: doosan mill-turn fanuc.cps
Look at this part of the code.  A 1/2" end mill is suppose be cutting a square around the 1" dia part.
It is like it is on the wrong plane. Attached is the sample drawing. 

G98 G18 M35
M90
G0 G28 H0.
T0303
G97 S3000 M33
G0 Z0.3
X1.4414 Y0.
C0.
G12.1
G1 X0.5566 C-0.6648 F59.055
Z0.1
Z0.0394 F10.
Z-1.2
X-0.5566 F3.5
Z0.2 F59.055
X-1.3149 C-0.2889
Z0.1
Z0.0394 F10.
Z-1.2
C0.2889 F3.5
Z0.2 F59.055
X-0.6724 C0.6194
Z0.1
Z0.0394 F10.
Z-1.2
X0.6724 F3.5
Z0.2 F59.055
X1.3266 C0.2805
Z0.1
Z0.0394 F10.
Z-1.2
C-0.2805 F3.5
Z0.3 F59.055
G13.1
M35

[steveKPRTN · Accepted solution]

Figured out something. In the header of the processor it says the ACTION command is "usePolarCoordinates", but instead it should say "useXZCMode". It works with that.

G98 G17 M35
M90
G0 G28 H0.
T0303
G97 S3000 M3 P12
G0 Z0.3
X1.4414 Y0. C-67.285
Z0.1
G1 Z0.0394 F10.
Z-1.2
X1.4381 C-67.605 F196.668
X1.4348 C-67.923 F198.033
X1.4316 C-68.241 F199.397
X1.4285 C-68.557 F200.758
X1.4254 C-68.873 F202.117
X1.4224 C-69.187 F203.473
X1.4195 C-69.5 F204.827
X1.4166 C-69.812 F206.178
X1.4138 C-70.122 F207.527
X1.4111 C-70.432 F208.872
X1.4084 C-70.74 F210.214
X1.4058 C-71.047 F211.554
X1.4033 C-71.353 F212.89
X1.4008 C-71.657 F214.223
X1.3983 C-71.96 F215.552
X1.396 C-72.262 F216.879
X1.3936 C-72.562 F218.201
X1.3914 C-72.861 F219.521
X1.3892 C-73.159 F220.836