Adding Feed Rate from Fusion to Post

[Anonymous]

Hey, so I'm working with a Shopsabre plasma post and I've gotten everything modified to how I need it format wise, but would like to implement the cutting rate of the plasma tool setup in fusion to the feed parameter in the post (the number that it currently has for the cutting feed rate is a arbitrary 39.3701 in/min, but these would eventually be setup to be specific rates for whatever materials we're cutting).  I'm not sure how to create this from scratch or what to call in the post to pull this information.

Currently it's just a static call 

writeBlock("F260XY");

in the onOpen function creating the last line of the header,

M65

(ORIGIN=TOP LEFT)

(IMPERIAL)

(ABSOLUTE)

G90

F260XY

But I would like the feed to be a dynamic number that would changed based on the tool setup in fusion, instead of having several different posts.

Any help would be appreciated.

[engineguy]

@Anonymous 

OK, to start with can you use the code shown below, it is from a Generic Plasma PP that might do the job for you, I have made a couple of adjustments in it, it does have both dwell and pierce height options but if not needed they can be disabled if you want, just look at the code below and let us know if it works for you and if not how close/how far is it from working 🙂 🙂 🙂

N10 G90
N15 G53
N20 G20
N25 M65

(2D Profile3)
N30 G0 X-0.35 Y0.0471
N35 M61
N40 G4 P1.
N45 G1 X-0.4077 Y-0.1411 F40.
N50 G1 X-0.3869 Y-0.1635
N55 G3 X0.0403 Y-0.3303 I0.3869 J0.3603
N60 G1 X0.0418 Y-0.3302
N65 G1 X1.0288
N70 G1 Y0.3042
N75 G1 X0.5335
N80 G2 X0.5143 Y0.3193 I0. J0.0197
N85 G3 X-0.5077 Y0.3442 I-0.5143 J-0.1225
N90 G2 X-0.5395 Y0.3347 I-0.0189 J0.0055
N95 G3 X-1.1141 Y-0.3347 I-0.2873 J-0.3347
N100 G3 X-0.4194 Y-0.1693 I0.2873 J0.3347
N105 G1 X-0.4077 Y-0.1411
N110 G1 X-0.2159 Y-0.0969
N115 M62
N120 G4 P2.

N125 M30

Stay Safe

Regards

Rob

[Anonymous]

@engineguy 

So it's pretty close.  I'll post the copy of the postprocessor I've been working on.  Essentially line 147 is outputting my feed, but its just a static code, no actual information is pulled from Fusion for it.  This is the area that I'm hoping to inject the feed rate into.

Everything else there seems to line up pretty close with what I've already got down and seems to be usable as is, I just want to build that feed rate intelligence into the post instead of having separate posts for each material.

Thanks for your help!

[engineguy]

@Anonymous 

Instead of trying to do more work on the PP you uploaded try using this one, I think it is a better PP for what you are looking to do 🙂 🙂 🙂

The one you have has not been updated for more than a year !!

Stay Safe

Regards

Rob

[bob.schultz · Accepted solution]

It is possible to get the cutting feedrate from Fusion in the onOpen function and output this value instead of a fixed feedrate.  Make the following change to get the feedrate for the first operation.

  var feed = getSection(0).getParameter("operation:tool_feedCutting", 260);
  writeBlock(feedOutput.format(feed) + "XY");
  //writeBlock("F260XY");

[Anonymous]

That worked perfectly!  Thanks for the help!  Can I ask what the 260 is at the end of the first line?

[infoL7PH9]

Is there a way I can get the current version of this post processor? I would like to use it with my Shop Sabre CNC Plasma.  Thank you!